KiCad PCB EDA Suite
DRC Class Reference

Class DRC is the Design Rule Checker, and performs all the DRC tests. More...

#include <drc_stuff.h>

Public Member Functions

 DRC (PCB_EDIT_FRAME *aPcbWindow)
 
 ~DRC ()
 
int Drc (TRACK *aRefSeg, TRACK *aList)
 Function Drc tests the current segment and returns the result and displays the error in the status panel only if one exists. More...
 
int Drc (ZONE_CONTAINER *aArea, int aCornerIndex)
 Function Drc tests the outline segment starting at CornerIndex and returns the result and displays the error in the status panel only if one exists. More...
 
int DrcBlind (TRACK *aRefSeg, TRACK *aList)
 Function DrcBlind tests the current segment and returns the result. More...
 
void ShowDRCDialog (wxWindow *aParent=NULL)
 Function ShowDRCDialog opens a dialog and prompts the user, then if a test run button is clicked, runs the test(s) and creates the MARKERS. More...
 
void DestroyDRCDialog (int aReason)
 Function DestroyDRCDialog deletes this ui dialog box and zeros out its pointer to remember the state of the dialog's existence. More...
 
void SetSettings (bool aPad2PadTest, bool aUnconnectedTest, bool aZonesTest, bool aKeepoutTest, bool aCourtyardTest, bool aCourtyardMissingTest, const wxString &aReportName, bool aSaveReport)
 Function SetSettings saves all the UI or test settings and may be called before running the tests. More...
 
void RunTests (wxTextCtrl *aMessages=NULL)
 Function RunTests will actually run all the tests specified with a previous call to SetSettings() More...
 
void ListUnconnectedPads ()
 Function ListUnconnectedPad gathers a list of all the unconnected pads and shows them in the dialog, and optionally prints a report of such. More...
 
MARKER_PCBGetCurrentMarker ()
 

Private Member Functions

void updatePointers ()
 Function updatePointers is a private helper function used to update needed pointers from the one pointer which is known not to change, m_pcbEditorFrame. More...
 
MARKER_PCBfillMarker (const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
 Function fillMarker optionally creates a marker and fills it in with information, but does not add it to the BOARD. More...
 
MARKER_PCBfillMarker (D_PAD *aPad, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
 
MARKER_PCBfillMarker (ZONE_CONTAINER *aArea, int aErrorCode, MARKER_PCB *fillMe)
 
MARKER_PCBfillMarker (const wxPoint &aPos, int aErrorCode, const wxString &aMessage, MARKER_PCB *fillMe)
 
MARKER_PCBfillMarker (const ZONE_CONTAINER *aArea, const wxPoint &aPos, int aErrorCode, MARKER_PCB *fillMe)
 Function fillMarker optionally creates a marker and fills it in with information, but does not add it to the BOARD. More...
 
MARKER_PCBfillMarker (int aErrorCode, const wxString &aMessage, MARKER_PCB *fillMe)
 Function fillMarker fills a MARKER which will report on a generic problem with the board which is not geographically locatable. More...
 
void addMarkerToPcb (MARKER_PCB *aMarker)
 Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism. More...
 
bool testNetClasses ()
 Function testNetClasses goes through each NETCLASS and verifies that its clearance, via size, track width, and track clearance are larger than those in board.m_designSettings. More...
 
void testTracks (wxWindow *aActiveWindow, bool aShowProgressBar)
 Function testTracks performs the DRC on all tracks. More...
 
void testPad2Pad ()
 
void testUnconnected ()
 
void testZones ()
 
void testKeepoutAreas ()
 
void testTexts ()
 
bool doNetClass (std::shared_ptr< NETCLASS > aNetClass, wxString &msg)
 
bool doPadToPadsDrc (D_PAD *aRefPad, D_PAD **aStart, D_PAD **aEnd, int x_limit)
 Function doPadToPadsDrc tests the clearance between aRefPad and other pads. More...
 
bool doTrackDrc (TRACK *aRefSeg, TRACK *aStart, bool doPads=true)
 Function DoTrackDrc tests the current segment. More...
 
bool doTrackKeepoutDrc (TRACK *aRefSeg)
 Function doTrackKeepoutDrc tests the current segment or via. More...
 
bool doEdgeZoneDrc (ZONE_CONTAINER *aArea, int aCornerIndex)
 Function doEdgeZoneDrc tests a segment in ZONE_CONTAINER * aArea: Test Edge inside other areas Test Edge too close other areas. More...
 
bool doFootprintOverlappingDrc ()
 Function doFootprintOverlappingDrc tests for footprint courtyard overlaps. More...
 
bool checkClearancePadToPad (D_PAD *aRefPad, D_PAD *aPad)
 Function checkClearancePadToPad. More...
 
bool checkClearanceSegmToPad (const D_PAD *aPad, int aSegmentWidth, int aMinDist)
 Function checkClearanceSegmToPad check the distance from a pad to segment. More...
 
bool checkLine (wxPoint aSegStart, wxPoint aSegEnd)
 Function checkLine (helper function used in drc calculations to see if one track is in contact with another track). More...
 

Static Private Member Functions

static bool checkMarginToCircle (wxPoint aCentre, int aRadius, int aLength)
 Helper function checkMarginToCircle Check the distance from a point to a segment. More...
 

Private Attributes

bool m_doPad2PadTest
 
bool m_doUnconnectedTest
 
bool m_doZonesTest
 
bool m_doKeepoutTest
 
bool m_doCreateRptFile
 
bool m_doFootprintOverlapping
 
bool m_doNoCourtyardDefined
 
wxString m_rptFilename
 
MARKER_PCBm_currentMarker
 
bool m_abortDRC
 
bool m_drcInProgress
 
wxPoint m_padToTestPos
 
wxPoint m_segmEnd
 
double m_segmAngle
 
int m_segmLength
 
int m_xcliplo
 
int m_ycliplo
 
int m_xcliphi
 
int m_ycliphi
 
PCB_EDIT_FRAMEm_pcbEditorFrame
 The pcb frame editor which owns the board. More...
 
BOARDm_pcb
 
DIALOG_DRC_CONTROLm_drcDialog
 
DRC_LIST m_unconnected
 list of unconnected pads, as DRC_ITEMs More...
 

Friends

class DIALOG_DRC_CONTROL
 

Detailed Description

Class DRC is the Design Rule Checker, and performs all the DRC tests.

The output of the checking goes to the BOARD file in the form of two MARKER lists. Those two lists are displayable in the drc dialog box. And they can optionally be sent to a text file on disk. This class is given access to the windows and the BOARD that it needs via its constructor or public access functions.

Definition at line 158 of file drc_stuff.h.

Constructor & Destructor Documentation

DRC::DRC ( PCB_EDIT_FRAME aPcbWindow)

Definition at line 113 of file drc.cpp.

References PCB_BASE_FRAME::GetBoard(), m_abortDRC, m_currentMarker, m_doCreateRptFile, m_doFootprintOverlapping, m_doKeepoutTest, m_doNoCourtyardDefined, m_doPad2PadTest, m_doUnconnectedTest, m_doZonesTest, m_drcDialog, m_drcInProgress, m_pcb, m_pcbEditorFrame, m_segmAngle, m_segmLength, m_xcliphi, m_xcliplo, m_ycliphi, and m_ycliplo.

114 {
115  m_pcbEditorFrame = aPcbWindow;
116  m_pcb = aPcbWindow->GetBoard();
117  m_drcDialog = NULL;
118 
119  // establish initial values for everything:
120  m_doPad2PadTest = true; // enable pad to pad clearance tests
121  m_doUnconnectedTest = true; // enable unconnected tests
122  m_doZonesTest = true; // enable zone to items clearance tests
123  m_doKeepoutTest = true; // enable keepout areas to items clearance tests
124  m_doFootprintOverlapping = true; // enable courtyards areas overlap tests
125  m_doNoCourtyardDefined = true; // enable missing courtyard in footprint warning
126  m_abortDRC = false;
127  m_drcInProgress = false;
128 
129  m_doCreateRptFile = false;
130 
131  // m_rptFilename set to empty by its constructor
132 
133  m_currentMarker = NULL;
134 
135  m_segmAngle = 0;
136  m_segmLength = 0;
137 
138  m_xcliplo = 0;
139  m_ycliplo = 0;
140  m_xcliphi = 0;
141  m_ycliphi = 0;
142 }
bool m_doNoCourtyardDefined
Definition: drc_stuff.h:172
bool m_doCreateRptFile
Definition: drc_stuff.h:170
DIALOG_DRC_CONTROL * m_drcDialog
Definition: drc_stuff.h:206
int m_ycliplo
Definition: drc_stuff.h:200
int m_ycliphi
Definition: drc_stuff.h:202
int m_segmLength
Definition: drc_stuff.h:194
BOARD * GetBoard() const
BOARD * m_pcb
Definition: drc_stuff.h:205
bool m_doFootprintOverlapping
Definition: drc_stuff.h:171
bool m_doKeepoutTest
Definition: drc_stuff.h:169
bool m_doZonesTest
Definition: drc_stuff.h:168
bool m_abortDRC
Definition: drc_stuff.h:178
bool m_drcInProgress
Definition: drc_stuff.h:179
int m_xcliphi
Definition: drc_stuff.h:201
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
bool m_doPad2PadTest
Definition: drc_stuff.h:166
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
int m_xcliplo
Definition: drc_stuff.h:199
bool m_doUnconnectedTest
Definition: drc_stuff.h:167
double m_segmAngle
Definition: drc_stuff.h:193
DRC::~DRC ( )

Definition at line 145 of file drc.cpp.

References m_unconnected.

146 {
147  // maybe someday look at pointainer.h <- google for "pointainer.h"
148  for( unsigned i = 0; i<m_unconnected.size(); ++i )
149  delete m_unconnected[i];
150 }
DRC_LIST m_unconnected
list of unconnected pads, as DRC_ITEMs
Definition: drc_stuff.h:208

Member Function Documentation

void DRC::addMarkerToPcb ( MARKER_PCB aMarker)
private

Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.

Definition at line 90 of file drc.cpp.

References COMMIT::Add(), m_pcbEditorFrame, and BOARD_COMMIT::Push().

Referenced by doFootprintOverlappingDrc(), doNetClass(), testKeepoutAreas(), testPad2Pad(), testTexts(), testTracks(), and testZones().

91 {
92  BOARD_COMMIT commit ( m_pcbEditorFrame );
93  commit.Add( aMarker );
94  commit.Push( wxEmptyString, false );
95 }
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
bool DRC::checkClearancePadToPad ( D_PAD aRefPad,
D_PAD aPad 
)
private

Function checkClearancePadToPad.

Parameters
aRefPadThe reference pad to check
aPadAnother pad to check against
Returns
bool - true if clearance between aRefPad and aPad is >= dist_min, else false

Definition at line 590 of file drc_clearance_test_functions.cpp.

References ArcTangente(), D_PAD::BuildPadPolygon(), checkClearanceSegmToPad(), SHAPE_POLY_SET::COutline(), SHAPE_LINE_CHAIN::CPoint(), dist, EuclideanNorm(), D_PAD::GetBoundingRadius(), D_PAD::GetClearance(), D_PAD::GetOrientation(), GetRoundRectCornerCenters(), D_PAD::GetRoundRectCornerRadius(), D_PAD::GetShape(), D_PAD::GetSize(), KiROUND(), m_padToTestPos, m_segmAngle, m_segmEnd, m_segmLength, NORMALIZE_ANGLE_POS(), SHAPE_POLY_SET::OutlineCount(), PAD_SHAPE_CIRCLE, PAD_SHAPE_OVAL, PAD_SHAPE_RECT, PAD_SHAPE_ROUNDRECT, PAD_SHAPE_TRAPEZOID, SHAPE_LINE_CHAIN::PointCount(), poly2polyDRC(), RotatePoint(), D_PAD::ShapePos(), wxPoint::x, and wxPoint::y.

Referenced by doPadToPadsDrc().

591 {
592  int dist;
593  double pad_angle;
594 
595  // Get the clearance between the 2 pads. this is the min distance between aRefPad and aPad
596  int dist_min = aRefPad->GetClearance( aPad );
597 
598  // relativePadPos is the aPad shape position relative to the aRefPad shape position
599  wxPoint relativePadPos = aPad->ShapePos() - aRefPad->ShapePos();
600 
601  dist = KiROUND( EuclideanNorm( relativePadPos ) );
602 
603  // Quick test: Clearance is OK if the bounding circles are further away than "dist_min"
604  if( (dist - aRefPad->GetBoundingRadius() - aPad->GetBoundingRadius()) >= dist_min )
605  return true;
606 
607  /* Here, pads are near and DRC depend on the pad shapes
608  * We must compare distance using a fine shape analysis
609  * Because a circle or oval shape is the easier shape to test, try to have
610  * aRefPad shape type = PAD_SHAPE_CIRCLE or PAD_SHAPE_OVAL.
611  * if aRefPad = TRAP. and aPad = RECT, also swap pads
612  * Swap aRefPad and aPad if needed
613  */
614  bool swap_pads;
615  swap_pads = false;
616 
617  // swap pads to make comparisons easier
618  // Note also a ROUNDRECT pad with a corner radius = r can be considered as
619  // a smaller RECT (size - 2*r) with a clearance increased by r
620  // priority is aRefPad = ROUND then OVAL then RECT/ROUNDRECT then other
621  if( aRefPad->GetShape() != aPad->GetShape() && aRefPad->GetShape() != PAD_SHAPE_CIRCLE )
622  {
623  // pad ref shape is here oval, rect, roundrect, trapezoid or custom
624  switch( aPad->GetShape() )
625  {
626  case PAD_SHAPE_CIRCLE:
627  swap_pads = true;
628  break;
629 
630  case PAD_SHAPE_OVAL:
631  swap_pads = true;
632  break;
633 
634  case PAD_SHAPE_RECT:
635  case PAD_SHAPE_ROUNDRECT:
636  if( aRefPad->GetShape() != PAD_SHAPE_OVAL )
637  swap_pads = true;
638  break;
639 
640  default:
641  break;
642  }
643  }
644 
645  if( swap_pads )
646  {
647  std::swap( aRefPad, aPad );
648  relativePadPos = -relativePadPos;
649  }
650 
651  // corners of aRefPad (used only for rect/roundrect/trap pad)
652  wxPoint polyref[4];
653  // corners of aRefPad (used only for custom pad)
654  SHAPE_POLY_SET polysetref;
655 
656  // corners of aPad (used only for rect/roundrect/trap pad)
657  wxPoint polycompare[4];
658  // corners of aPad (used only custom pad)
659  SHAPE_POLY_SET polysetcompare;
660 
661  /* Because pad exchange, aRefPad shape is PAD_SHAPE_CIRCLE or PAD_SHAPE_OVAL,
662  * if one of the 2 pads was a PAD_SHAPE_CIRCLE or PAD_SHAPE_OVAL.
663  * Therefore, if aRefPad is a PAD_SHAPE_RECT, PAD_SHAPE_ROUNDRECT or a PAD_SHAPE_TRAPEZOID,
664  * aPad is also a PAD_SHAPE_RECT, PAD_SHAPE_ROUNDRECT or a PAD_SHAPE_TRAPEZOID
665  */
666  bool diag = true;
667 
668  switch( aRefPad->GetShape() )
669  {
670  case PAD_SHAPE_CIRCLE:
671 
672  /* One can use checkClearanceSegmToPad to test clearance
673  * aRefPad is like a track segment with a null length and a witdth = GetSize().x
674  */
675  m_segmLength = 0;
676  m_segmAngle = 0;
677 
678  m_segmEnd.x = m_segmEnd.y = 0;
679 
680  m_padToTestPos = relativePadPos;
681  diag = checkClearanceSegmToPad( aPad, aRefPad->GetSize().x, dist_min );
682  break;
683 
684  case PAD_SHAPE_TRAPEZOID:
685  case PAD_SHAPE_ROUNDRECT:
686  case PAD_SHAPE_RECT:
687  // pad_angle = pad orient relative to the aRefPad orient
688  pad_angle = aRefPad->GetOrientation() + aPad->GetOrientation();
689  NORMALIZE_ANGLE_POS( pad_angle );
690 
691  if( aRefPad->GetShape() == PAD_SHAPE_ROUNDRECT )
692  {
693  int padRadius = aRefPad->GetRoundRectCornerRadius();
694  dist_min += padRadius;
695  GetRoundRectCornerCenters( polyref, padRadius, wxPoint( 0, 0 ),
696  aRefPad->GetSize(), aRefPad->GetOrientation() );
697  }
698  else
699  aRefPad->BuildPadPolygon( polyref, wxSize( 0, 0 ), aRefPad->GetOrientation() );
700 
701  switch( aPad->GetShape() )
702  {
703  case PAD_SHAPE_ROUNDRECT:
704  case PAD_SHAPE_RECT:
705  case PAD_SHAPE_TRAPEZOID:
706  if( aPad->GetShape() == PAD_SHAPE_ROUNDRECT )
707  {
708  int padRadius = aPad->GetRoundRectCornerRadius();
709  dist_min += padRadius;
710  GetRoundRectCornerCenters( polycompare, padRadius, relativePadPos,
711  aPad->GetSize(), aPad->GetOrientation() );
712  }
713  else
714  {
715  aPad->BuildPadPolygon( polycompare, wxSize( 0, 0 ), aPad->GetOrientation() );
716 
717  // Move aPad shape to relativePadPos
718  for( int ii = 0; ii < 4; ii++ )
719  polycompare[ii] += relativePadPos;
720  }
721 
722  // And now test polygons:
723  if( polysetref.OutlineCount() )
724  {
725  const SHAPE_LINE_CHAIN& refpoly = polysetref.COutline( 0 );
726  // And now test polygons:
727  if( !poly2polyDRC( (wxPoint*) &refpoly.CPoint( 0 ), refpoly.PointCount(),
728  polycompare, 4, dist_min ) )
729  diag = false;
730  }
731  else if( !poly2polyDRC( polyref, 4, polycompare, 4, dist_min ) )
732  diag = false;
733  break;
734 
735  default:
736  wxLogDebug( wxT( "DRC::checkClearancePadToPad: unexpected pad shape %d" ), aPad->GetShape() );
737  break;
738  }
739  break;
740 
741  case PAD_SHAPE_OVAL: /* an oval pad is like a track segment */
742  {
743  /* Create a track segment with same dimensions as the oval aRefPad
744  * and use checkClearanceSegmToPad function to test aPad to aRefPad clearance
745  */
746  int segm_width;
747  m_segmAngle = aRefPad->GetOrientation(); // Segment orient.
748 
749  if( aRefPad->GetSize().y < aRefPad->GetSize().x ) // Build an horizontal equiv segment
750  {
751  segm_width = aRefPad->GetSize().y;
752  m_segmLength = aRefPad->GetSize().x - aRefPad->GetSize().y;
753  }
754  else // Vertical oval: build an horizontal equiv segment and rotate 90.0 deg
755  {
756  segm_width = aRefPad->GetSize().x;
757  m_segmLength = aRefPad->GetSize().y - aRefPad->GetSize().x;
758  m_segmAngle += 900;
759  }
760 
761  /* the start point must be 0,0 and currently relativePadPos
762  * is relative the center of pad coordinate */
763  wxPoint segstart;
764  segstart.x = -m_segmLength / 2; // Start point coordinate of the horizontal equivalent segment
765 
766  RotatePoint( &segstart, m_segmAngle ); // actual start point coordinate of the equivalent segment
767  // Calculate segment end position relative to the segment origin
768  m_segmEnd.x = -2 * segstart.x;
769  m_segmEnd.y = -2 * segstart.y;
770 
771  // Recalculate the equivalent segment angle in 0,1 degrees
772  // to prepare a call to checkClearanceSegmToPad()
774 
775  // move pad position relative to the segment origin
776  m_padToTestPos = relativePadPos - segstart;
777 
778  // Use segment to pad check to test the second pad:
779  diag = checkClearanceSegmToPad( aPad, segm_width, dist_min );
780  break;
781  }
782 
783  default:
784  wxLogDebug( wxT( "DRC::checkClearancePadToPad: unknown pad shape" ) );
785  break;
786  }
787 
788  return diag;
789 }
double EuclideanNorm(const wxPoint &vector)
Euclidean norm of a 2D vector.
Definition: trigo.h:104
static int KiROUND(double v)
KiROUND rounds a floating point number to an int using "round halfway cases away from zero"...
Definition: common.h:107
void BuildPadPolygon(wxPoint aCoord[4], wxSize aInflateValue, double aRotation) const
Function BuildPadPolygon Has meaning only for polygonal pads (trapezoid and rectangular) Build the Co...
int PointCount() const
Function PointCount()
int GetRoundRectCornerRadius() const
Function GetRoundRectCornerRadius Has meaning only for rounded rect pads.
Definition: class_pad.h:351
static const int dist[10][10]
Definition: dist.cpp:57
int m_segmLength
Definition: drc_stuff.h:194
void RotatePoint(int *pX, int *pY, double angle)
Definition: trigo.cpp:317
int OutlineCount() const
Returns the number of outlines in the set
void NORMALIZE_ANGLE_POS(T &Angle)
Definition: trigo.h:222
wxPoint m_padToTestPos
Definition: drc_stuff.h:185
PAD_SHAPE_T GetShape() const
Function GetShape.
Definition: class_pad.h:166
double ArcTangente(int dy, int dx)
Definition: trigo.cpp:271
int GetBoundingRadius() const
Function GetBoundingRadius returns the radius of a minimum sized circle which fully encloses this pad...
Definition: class_pad.h:428
Class SHAPE_POLY_SET.
const wxSize & GetSize() const
Definition: class_pad.h:182
const SHAPE_LINE_CHAIN & COutline(int aIndex) const
bool checkClearanceSegmToPad(const D_PAD *aPad, int aSegmentWidth, int aMinDist)
Function checkClearanceSegmToPad check the distance from a pad to segment.
wxPoint m_segmEnd
Definition: drc_stuff.h:186
Class SHAPE_LINE_CHAIN.
double GetOrientation() const
Function GetOrientation returns the rotation angle of the pad in tenths of degrees, but soon degrees.
Definition: class_pad.h:214
bool poly2polyDRC(wxPoint *aTref, int aTrefCount, wxPoint *aTcompare, int aTcompareCount, int aDist)
DRC control: these functions make a DRC between pads, tracks and pads versus tracks.
void GetRoundRectCornerCenters(wxPoint aCenters[4], int aRadius, const wxPoint &aPosition, const wxSize &aSize, double aRotation)
Helper function GetRoundRectCornerCenters Has meaning only for rounded rect Returns the centers of th...
int GetClearance(BOARD_CONNECTED_ITEM *aItem=NULL) const override
Function GetClearance returns the clearance in internal units.
Definition: class_pad.cpp:455
wxPoint ShapePos() const
Definition: class_pad.cpp:367
const VECTOR2I & CPoint(int aIndex) const
Function CPoint()
double m_segmAngle
Definition: drc_stuff.h:193
bool DRC::checkClearanceSegmToPad ( const D_PAD aPad,
int  aSegmentWidth,
int  aMinDist 
)
private

Function checkClearanceSegmToPad check the distance from a pad to segment.

This function uses several instance variable not passed in: m_segmLength = length of the segment being tested m_segmAngle = angle of the segment with the X axis; m_segmEnd = end coordinate of the segment m_padToTestPos = position of pad relative to the origin of segment

Parameters
aPadIs the pad involved in the check
aSegmentWidthwidth of the segment to test
aMinDistIs the minimum clearance needed
Returns
true distance >= dist_min, false if distance < dist_min

Definition at line 797 of file drc_clearance_test_functions.cpp.

References abs, AddAngles(), D_PAD::BuildPadPolygon(), checkLine(), checkMarginToCircle(), D_PAD::GetDelta(), D_PAD::GetOrientation(), D_PAD::GetRoundRectCornerRadius(), D_PAD::GetShape(), D_PAD::GetSize(), m_padToTestPos, m_segmAngle, m_segmEnd, m_segmLength, m_xcliphi, m_xcliplo, m_ycliphi, m_ycliplo, PAD_SHAPE_CIRCLE, PAD_SHAPE_OVAL, PAD_SHAPE_RECT, PAD_SHAPE_ROUNDRECT, PAD_SHAPE_TRAPEZOID, poly2segmentDRC(), RotatePoint(), wxPoint::x, and wxPoint::y.

Referenced by checkClearancePadToPad(), doTrackDrc(), and testTexts().

798 {
799  wxSize padHalfsize; // half dimension of the pad
800  int r;
801 
802  int segmHalfWidth = aSegmentWidth / 2;
803  int distToLine = segmHalfWidth + aMinDist;
804 
805  padHalfsize.x = aPad->GetSize().x >> 1;
806  padHalfsize.y = aPad->GetSize().y >> 1;
807 
808  if( aPad->GetShape() == PAD_SHAPE_TRAPEZOID ) // The size is bigger, due to GetDelta() extra size
809  {
810  padHalfsize.x += std::abs(aPad->GetDelta().y) / 2; // Remember: GetDelta().y is the GetSize().x change
811  padHalfsize.y += std::abs(aPad->GetDelta().x) / 2; // Remember: GetDelta().x is the GetSize().y change
812  }
813 
814  if( aPad->GetShape() == PAD_SHAPE_CIRCLE )
815  {
816  /* Easy case: just test the distance between segment and pad centre
817  * calculate pad coordinates in the X,Y axis with X axis = segment to test
818  */
820  return checkMarginToCircle( m_padToTestPos, distToLine + padHalfsize.x, m_segmLength );
821  }
822 
823  /* calculate the bounding box of the pad, including the clearance and the segment width
824  * if the line from 0 to m_segmEnd does not intersect this bounding box,
825  * the clearance is always OK
826  * But if intersect, a better analysis of the pad shape must be done.
827  */
828  m_xcliplo = m_padToTestPos.x - distToLine - padHalfsize.x;
829  m_ycliplo = m_padToTestPos.y - distToLine - padHalfsize.y;
830  m_xcliphi = m_padToTestPos.x + distToLine + padHalfsize.x;
831  m_ycliphi = m_padToTestPos.y + distToLine + padHalfsize.y;
832 
833  wxPoint startPoint;
834  wxPoint endPoint = m_segmEnd;
835 
836  double orient = aPad->GetOrientation();
837 
838  RotatePoint( &startPoint, m_padToTestPos, -orient );
839  RotatePoint( &endPoint, m_padToTestPos, -orient );
840 
841  if( checkLine( startPoint, endPoint ) )
842  return true;
843 
844  /* segment intersects the bounding box. But there is not always a DRC error.
845  * A fine analysis of the pad shape must be done.
846  */
847  switch( aPad->GetShape() )
848  {
849  default:
850  return false;
851 
852  case PAD_SHAPE_OVAL:
853  {
854  /* an oval is a complex shape, but is a rectangle and 2 circles
855  * these 3 basic shapes are more easy to test.
856  *
857  * In calculations we are using a vertical oval shape
858  * (i.e. a vertical rounded segment)
859  * for horizontal oval shapes, swap x and y size and rotate the shape
860  */
861  if( padHalfsize.x > padHalfsize.y )
862  {
863  std::swap( padHalfsize.x, padHalfsize.y );
864  orient = AddAngles( orient, 900 );
865  }
866 
867  // here, padHalfsize.x is the radius of rounded ends.
868 
869  int deltay = padHalfsize.y - padHalfsize.x;
870  // here: padHalfsize.x = radius,
871  // deltay = dist between the centre pad and the centre of a rounded end
872 
873  // Test the rectangular area between the two circles (the rounded ends)
874  m_xcliplo = m_padToTestPos.x - distToLine - padHalfsize.x;
875  m_ycliplo = m_padToTestPos.y - deltay;
876  m_xcliphi = m_padToTestPos.x + distToLine + padHalfsize.x;
877  m_ycliphi = m_padToTestPos.y + deltay;
878 
879  if( !checkLine( startPoint, endPoint ) )
880  {
881  return false;
882  }
883 
884  // test the first circle
885  startPoint.x = m_padToTestPos.x; // startPoint = centre of the upper circle of the oval shape
886  startPoint.y = m_padToTestPos.y + deltay;
887 
888  // Calculate the actual position of the circle, given the pad orientation:
889  RotatePoint( &startPoint, m_padToTestPos, orient );
890 
891  // Calculate the actual position of the circle in the new X,Y axis:
892  RotatePoint( &startPoint, m_segmAngle );
893 
894  if( !checkMarginToCircle( startPoint, padHalfsize.x + distToLine, m_segmLength ) )
895  {
896  return false;
897  }
898 
899  // test the second circle
900  startPoint.x = m_padToTestPos.x; // startPoint = centre of the lower circle of the oval shape
901  startPoint.y = m_padToTestPos.y - deltay;
902  RotatePoint( &startPoint, m_padToTestPos, orient );
903  RotatePoint( &startPoint, m_segmAngle );
904 
905  if( !checkMarginToCircle( startPoint, padHalfsize.x + distToLine, m_segmLength ) )
906  {
907  return false;
908  }
909  }
910  break;
911 
912  case PAD_SHAPE_ROUNDRECT:
913  // a round rect is a smaller rect, with a clearance augmented by the corners radius
914  r = aPad->GetRoundRectCornerRadius();
915  padHalfsize.x -= r;
916  padHalfsize.y -= r;
917  distToLine += r;
918  // Fall through
919  case PAD_SHAPE_RECT:
920  // the area to test is a rounded rectangle.
921  // this can be done by testing 2 rectangles and 4 circles (the corners)
922 
923  // Testing the first rectangle dimx + distToLine, dimy:
924  m_xcliplo = m_padToTestPos.x - padHalfsize.x - distToLine;
925  m_ycliplo = m_padToTestPos.y - padHalfsize.y;
926  m_xcliphi = m_padToTestPos.x + padHalfsize.x + distToLine;
927  m_ycliphi = m_padToTestPos.y + padHalfsize.y;
928 
929  if( !checkLine( startPoint, endPoint ) )
930  return false;
931 
932  // Testing the second rectangle dimx , dimy + distToLine
933  m_xcliplo = m_padToTestPos.x - padHalfsize.x;
934  m_ycliplo = m_padToTestPos.y - padHalfsize.y - distToLine;
935  m_xcliphi = m_padToTestPos.x + padHalfsize.x;
936  m_ycliphi = m_padToTestPos.y + padHalfsize.y + distToLine;
937 
938  if( !checkLine( startPoint, endPoint ) )
939  return false;
940 
941  // testing the 4 circles which are the clearance area of each corner:
942 
943  // testing the left top corner of the rectangle
944  startPoint.x = m_padToTestPos.x - padHalfsize.x;
945  startPoint.y = m_padToTestPos.y - padHalfsize.y;
946  RotatePoint( &startPoint, m_padToTestPos, orient );
947  RotatePoint( &startPoint, m_segmAngle );
948 
949  if( !checkMarginToCircle( startPoint, distToLine, m_segmLength ) )
950  return false;
951 
952  // testing the right top corner of the rectangle
953  startPoint.x = m_padToTestPos.x + padHalfsize.x;
954  startPoint.y = m_padToTestPos.y - padHalfsize.y;
955  RotatePoint( &startPoint, m_padToTestPos, orient );
956  RotatePoint( &startPoint, m_segmAngle );
957 
958  if( !checkMarginToCircle( startPoint, distToLine, m_segmLength ) )
959  return false;
960 
961  // testing the left bottom corner of the rectangle
962  startPoint.x = m_padToTestPos.x - padHalfsize.x;
963  startPoint.y = m_padToTestPos.y + padHalfsize.y;
964  RotatePoint( &startPoint, m_padToTestPos, orient );
965  RotatePoint( &startPoint, m_segmAngle );
966 
967  if( !checkMarginToCircle( startPoint, distToLine, m_segmLength ) )
968  return false;
969 
970  // testing the right bottom corner of the rectangle
971  startPoint.x = m_padToTestPos.x + padHalfsize.x;
972  startPoint.y = m_padToTestPos.y + padHalfsize.y;
973  RotatePoint( &startPoint, m_padToTestPos, orient );
974  RotatePoint( &startPoint, m_segmAngle );
975 
976  if( !checkMarginToCircle( startPoint, distToLine, m_segmLength ) )
977  return false;
978 
979  break;
980 
981  case PAD_SHAPE_TRAPEZOID:
982  {
983  wxPoint poly[4];
984  aPad->BuildPadPolygon( poly, wxSize( 0, 0 ), orient );
985 
986  // Move shape to m_padToTestPos
987  for( int ii = 0; ii < 4; ii++ )
988  {
989  poly[ii] += m_padToTestPos;
990  RotatePoint( &poly[ii], m_segmAngle );
991  }
992 
993  if( !poly2segmentDRC( poly, 4, wxPoint( 0, 0 ), wxPoint(m_segmLength,0), distToLine ) )
994  return false;
995 
996  break;
997  }
998  }
999 
1000  return true;
1001 }
int m_ycliplo
Definition: drc_stuff.h:200
void BuildPadPolygon(wxPoint aCoord[4], wxSize aInflateValue, double aRotation) const
Function BuildPadPolygon Has meaning only for polygonal pads (trapezoid and rectangular) Build the Co...
int GetRoundRectCornerRadius() const
Function GetRoundRectCornerRadius Has meaning only for rounded rect pads.
Definition: class_pad.h:351
int m_ycliphi
Definition: drc_stuff.h:202
bool poly2segmentDRC(wxPoint *aTref, int aTrefCount, wxPoint aSegStart, wxPoint aSegEnd, int aDist)
int m_segmLength
Definition: drc_stuff.h:194
void RotatePoint(int *pX, int *pY, double angle)
Definition: trigo.cpp:317
wxPoint m_padToTestPos
Definition: drc_stuff.h:185
PAD_SHAPE_T GetShape() const
Function GetShape.
Definition: class_pad.h:166
#define abs(a)
Definition: auxiliary.h:84
bool checkLine(wxPoint aSegStart, wxPoint aSegEnd)
Function checkLine (helper function used in drc calculations to see if one track is in contact with a...
T AddAngles(T a1, T2 a2)
Add two angles (keeping the result normalized). T2 is here.
Definition: trigo.h:246
const wxSize & GetSize() const
Definition: class_pad.h:182
static bool checkMarginToCircle(wxPoint aCentre, int aRadius, int aLength)
Helper function checkMarginToCircle Check the distance from a point to a segment. ...
int m_xcliphi
Definition: drc_stuff.h:201
wxPoint m_segmEnd
Definition: drc_stuff.h:186
double GetOrientation() const
Function GetOrientation returns the rotation angle of the pad in tenths of degrees, but soon degrees.
Definition: class_pad.h:214
const wxSize & GetDelta() const
Definition: class_pad.h:185
int m_xcliplo
Definition: drc_stuff.h:199
double m_segmAngle
Definition: drc_stuff.h:193
bool DRC::checkLine ( wxPoint  aSegStart,
wxPoint  aSegEnd 
)
private

Function checkLine (helper function used in drc calculations to see if one track is in contact with another track).

Helper function checkLine Test if a line intersects a bounding box (a rectangle) The rectangle is defined by m_xcliplo, m_ycliplo and m_xcliphi, m_ycliphi return true if the line from aSegStart to aSegEnd is outside the bounding box.

Test if a line intersects a bounding box (a rectangle) The rectangle is defined by m_xcliplo, m_ycliplo and m_xcliphi, m_ycliphi return true if the line from aSegStart to aSegEnd is outside the bounding box

Definition at line 1048 of file drc_clearance_test_functions.cpp.

References m_xcliphi, m_xcliplo, m_ycliphi, m_ycliplo, USCALE(), WHEN_INSIDE, WHEN_OUTSIDE, wxPoint::x, and wxPoint::y.

Referenced by checkClearanceSegmToPad(), and doTrackDrc().

1049 {
1050 #define WHEN_OUTSIDE return true
1051 #define WHEN_INSIDE
1052  int temp;
1053 
1054  if( aSegStart.x > aSegEnd.x )
1055  std::swap( aSegStart, aSegEnd );
1056 
1057  if( (aSegEnd.x < m_xcliplo) || (aSegStart.x > m_xcliphi) )
1058  {
1059  WHEN_OUTSIDE;
1060  }
1061 
1062  if( aSegStart.y < aSegEnd.y )
1063  {
1064  if( (aSegEnd.y < m_ycliplo) || (aSegStart.y > m_ycliphi) )
1065  {
1066  WHEN_OUTSIDE;
1067  }
1068 
1069  if( aSegStart.y < m_ycliplo )
1070  {
1071  temp = USCALE( (aSegEnd.x - aSegStart.x), (m_ycliplo - aSegStart.y),
1072  (aSegEnd.y - aSegStart.y) );
1073 
1074  if( (aSegStart.x += temp) > m_xcliphi )
1075  {
1076  WHEN_OUTSIDE;
1077  }
1078 
1079  aSegStart.y = m_ycliplo;
1080  WHEN_INSIDE;
1081  }
1082 
1083  if( aSegEnd.y > m_ycliphi )
1084  {
1085  temp = USCALE( (aSegEnd.x - aSegStart.x), (aSegEnd.y - m_ycliphi),
1086  (aSegEnd.y - aSegStart.y) );
1087 
1088  if( (aSegEnd.x -= temp) < m_xcliplo )
1089  {
1090  WHEN_OUTSIDE;
1091  }
1092 
1093  aSegEnd.y = m_ycliphi;
1094  WHEN_INSIDE;
1095  }
1096 
1097  if( aSegStart.x < m_xcliplo )
1098  {
1099  temp = USCALE( (aSegEnd.y - aSegStart.y), (m_xcliplo - aSegStart.x),
1100  (aSegEnd.x - aSegStart.x) );
1101  aSegStart.y += temp;
1102  aSegStart.x = m_xcliplo;
1103  WHEN_INSIDE;
1104  }
1105 
1106  if( aSegEnd.x > m_xcliphi )
1107  {
1108  temp = USCALE( (aSegEnd.y - aSegStart.y), (aSegEnd.x - m_xcliphi),
1109  (aSegEnd.x - aSegStart.x) );
1110  aSegEnd.y -= temp;
1111  aSegEnd.x = m_xcliphi;
1112  WHEN_INSIDE;
1113  }
1114  }
1115  else
1116  {
1117  if( (aSegStart.y < m_ycliplo) || (aSegEnd.y > m_ycliphi) )
1118  {
1119  WHEN_OUTSIDE;
1120  }
1121 
1122  if( aSegStart.y > m_ycliphi )
1123  {
1124  temp = USCALE( (aSegEnd.x - aSegStart.x), (aSegStart.y - m_ycliphi),
1125  (aSegStart.y - aSegEnd.y) );
1126 
1127  if( (aSegStart.x += temp) > m_xcliphi )
1128  {
1129  WHEN_OUTSIDE;
1130  }
1131 
1132  aSegStart.y = m_ycliphi;
1133  WHEN_INSIDE;
1134  }
1135 
1136  if( aSegEnd.y < m_ycliplo )
1137  {
1138  temp = USCALE( (aSegEnd.x - aSegStart.x), (m_ycliplo - aSegEnd.y),
1139  (aSegStart.y - aSegEnd.y) );
1140 
1141  if( (aSegEnd.x -= temp) < m_xcliplo )
1142  {
1143  WHEN_OUTSIDE;
1144  }
1145 
1146  aSegEnd.y = m_ycliplo;
1147  WHEN_INSIDE;
1148  }
1149 
1150  if( aSegStart.x < m_xcliplo )
1151  {
1152  temp = USCALE( (aSegStart.y - aSegEnd.y), (m_xcliplo - aSegStart.x),
1153  (aSegEnd.x - aSegStart.x) );
1154  aSegStart.y -= temp;
1155  aSegStart.x = m_xcliplo;
1156  WHEN_INSIDE;
1157  }
1158 
1159  if( aSegEnd.x > m_xcliphi )
1160  {
1161  temp = USCALE( (aSegStart.y - aSegEnd.y), (aSegEnd.x - m_xcliphi),
1162  (aSegEnd.x - aSegStart.x) );
1163  aSegEnd.y += temp;
1164  aSegEnd.x = m_xcliphi;
1165  WHEN_INSIDE;
1166  }
1167  }
1168 
1169  if( ( (aSegEnd.x + aSegStart.x) / 2 <= m_xcliphi )
1170  && ( (aSegEnd.x + aSegStart.x) / 2 >= m_xcliplo ) \
1171  && ( (aSegEnd.y + aSegStart.y) / 2 <= m_ycliphi )
1172  && ( (aSegEnd.y + aSegStart.y) / 2 >= m_ycliplo ) )
1173  {
1174  return false;
1175  }
1176  else
1177  {
1178  return true;
1179  }
1180 }
static int USCALE(unsigned arg, unsigned num, unsigned den)
#define WHEN_OUTSIDE
int m_ycliplo
Definition: drc_stuff.h:200
int m_ycliphi
Definition: drc_stuff.h:202
int m_xcliphi
Definition: drc_stuff.h:201
#define WHEN_INSIDE
int m_xcliplo
Definition: drc_stuff.h:199
bool DRC::checkMarginToCircle ( wxPoint  aCentre,
int  aRadius,
int  aLength 
)
staticprivate

Helper function checkMarginToCircle Check the distance from a point to a segment.

Helper function checkMarginToCircle Check the distance between a circle (round pad, via or round end of track) and a segment.

The segment is expected starting at 0,0, and on the X axis (used to test DRC between a segment and a round pad, via or round end of a track

Parameters
aCentreThe coordinate of the circle's center
aRadiusA "keep out" radius centered over the circle
aLengthThe length of the segment (i.e. coordinate of end, because it is on the X axis)
Returns
bool - true if distance >= radius, else false when distance < aRadius

the segment is expected starting at 0,0, and on the X axis return true if distance >= aRadius

Definition at line 1010 of file drc_clearance_test_functions.cpp.

References abs, EuclideanNorm(), wxPoint::x, and wxPoint::y.

Referenced by checkClearanceSegmToPad(), and doTrackDrc().

1011 {
1012  if( abs( aCentre.y ) >= aRadius ) // trivial case
1013  return true;
1014 
1015  // Here, distance between aCentre and X axis is < aRadius
1016  if( (aCentre.x > -aRadius ) && ( aCentre.x < (aLength + aRadius) ) )
1017  {
1018  if( (aCentre.x >= 0) && (aCentre.x <= aLength) )
1019  return false; // aCentre is between the starting point and the ending point of the segm
1020 
1021  if( aCentre.x > aLength ) // aCentre is after the ending point
1022  aCentre.x -= aLength; // move aCentre to the starting point of the segment
1023 
1024  if( EuclideanNorm( aCentre ) < aRadius )
1025  // distance between aCentre and the starting point or the ending point is < aRadius
1026  return false;
1027  }
1028 
1029  return true;
1030 }
double EuclideanNorm(const wxPoint &vector)
Euclidean norm of a 2D vector.
Definition: trigo.h:104
#define abs(a)
Definition: auxiliary.h:84
void DRC::DestroyDRCDialog ( int  aReason)

Function DestroyDRCDialog deletes this ui dialog box and zeros out its pointer to remember the state of the dialog's existence.

Parameters
aReasonIndication of which button was clicked to cause the destruction. if aReason == wxID_OK, design parameters values which can be entered from the dialog will bbe saved in design parameters list

Definition at line 97 of file drc.cpp.

References DIALOG_DRC_CONTROL::GetRptSettings(), m_doCreateRptFile, m_drcDialog, and m_rptFilename.

Referenced by DIALOG_DRC_CONTROL::OnActivateDlg(), DIALOG_DRC_CONTROL::OnCancelClick(), DIALOG_DRC_CONTROL::OnOkClick(), and DIALOG_PLOT::onRunDRC().

98 {
99  if( m_drcDialog )
100  {
101  if( aReason == wxID_OK )
102  {
103  // if user clicked OK, save his choices in this DRC object.
105  }
106 
107  m_drcDialog->Destroy();
108  m_drcDialog = NULL;
109  }
110 }
bool m_doCreateRptFile
Definition: drc_stuff.h:170
DIALOG_DRC_CONTROL * m_drcDialog
Definition: drc_stuff.h:206
void GetRptSettings(bool *aEnable, wxString &aFileName)
Definition: dialog_drc.cpp:164
wxString m_rptFilename
Definition: drc_stuff.h:174
bool DRC::doEdgeZoneDrc ( ZONE_CONTAINER aArea,
int  aCornerIndex 
)
private

Function doEdgeZoneDrc tests a segment in ZONE_CONTAINER * aArea: Test Edge inside other areas Test Edge too close other areas.

Parameters
aAreaThe current area.
aCornerIndexThe first corner of the segment to test.
Returns
bool - false if DRC error or true if OK

Definition at line 443 of file zones_test_and_combine_areas.cpp.

References SEG::A, SEG::B, SHAPE_POLY_SET::Contains(), COPPERAREA_CLOSE_TO_COPPERAREA, COPPERAREA_INSIDE_COPPERAREA, fillMarker(), BOARD::GetArea(), BOARD::GetAreaCount(), GetClearanceBetweenSegments(), ZONE_CONTAINER::GetIsKeepout(), BOARD_ITEM::GetLayer(), BOARD_CONNECTED_ITEM::GetNetCode(), ZONE_CONTAINER::GetPriority(), SHAPE_POLY_SET::GetRelativeIndices(), ZONE_CONTAINER::GetZoneClearance(), ZONE_CONTAINER::IsOnCopperLayer(), SHAPE_POLY_SET::IterateSegmentsWithHoles(), SHAPE_POLY_SET::VERTEX_INDEX::m_contour, m_currentMarker, m_pcb, SHAPE_POLY_SET::VERTEX_INDEX::m_polygon, SHAPE_POLY_SET::VERTEX_INDEX::m_vertex, max, ZONE_CONTAINER::Outline(), SHAPE_POLY_SET::Polygon(), SHAPE_LINE_CHAIN::Segment(), VECTOR2< T >::x, and VECTOR2< T >::y.

Referenced by Drc().

444 {
445  if( !aArea->IsOnCopperLayer() ) // Cannot have a Drc error if not on copper layer
446  return true;
447  // Get polygon, contour and vertex index.
449 
450  // If the vertex does not exist, there is no conflict
451  if( !aArea->Outline()->GetRelativeIndices( aCornerIndex, &index ) )
452  return true;
453 
454  // Retrieve the selected contour
455  SHAPE_LINE_CHAIN contour;
456  contour = aArea->Outline()->Polygon( index.m_polygon )[index.m_contour];
457 
458  // Retrieve the segment that starts at aCornerIndex-th corner.
459  SEG selectedSegment = contour.Segment( index.m_vertex );
460 
461  VECTOR2I start = selectedSegment.A;
462  VECTOR2I end = selectedSegment.B;
463 
464  // iterate through all areas
465  for( int ia2 = 0; ia2 < m_pcb->GetAreaCount(); ia2++ )
466  {
467  ZONE_CONTAINER* area_to_test = m_pcb->GetArea( ia2 );
468  int zone_clearance = std::max( area_to_test->GetZoneClearance(),
469  aArea->GetZoneClearance() );
470 
471  // test for same layer
472  if( area_to_test->GetLayer() != aArea->GetLayer() )
473  continue;
474 
475  // Test for same net
476  if( ( aArea->GetNetCode() == area_to_test->GetNetCode() ) && (aArea->GetNetCode() >= 0) )
477  continue;
478 
479  // test for same priority
480  if( area_to_test->GetPriority() != aArea->GetPriority() )
481  continue;
482 
483  // test for same type
484  if( area_to_test->GetIsKeepout() != aArea->GetIsKeepout() )
485  continue;
486 
487  // For keepout, there is no clearance, so use a minimal value for it
488  // use 1, not 0 as value to avoid some issues in tests
489  if( area_to_test->GetIsKeepout() )
490  zone_clearance = 1;
491 
492  // test for ending line inside area_to_test
493  if( area_to_test->Outline()->Contains( end ) )
494  {
495  // COPPERAREA_COPPERAREA error: corner inside copper area
496  m_currentMarker = fillMarker( aArea, static_cast<wxPoint>( end ),
498  m_currentMarker );
499  return false;
500  }
501 
502  // now test spacing between areas
503  int ax1 = start.x;
504  int ay1 = start.y;
505  int ax2 = end.x;
506  int ay2 = end.y;
507 
508  // Iterate through all edges in the polygon.
510  for( iterator = area_to_test->Outline()->IterateSegmentsWithHoles(); iterator; iterator++ )
511  {
512  SEG segment = *iterator;
513 
514  int bx1 = segment.A.x;
515  int by1 = segment.A.y;
516  int bx2 = segment.B.x;
517  int by2 = segment.B.y;
518 
519  int x, y; // variables containing the intersecting point coordinates
520  int d = GetClearanceBetweenSegments( bx1, by1, bx2, by2,
521  0,
522  ax1, ay1, ax2, ay2,
523  0,
524  zone_clearance,
525  &x, &y );
526 
527  if( d < zone_clearance )
528  {
529  // COPPERAREA_COPPERAREA error : edge intersect or too close
530  m_currentMarker = fillMarker( aArea, wxPoint( x, y ),
532  m_currentMarker );
533  return false;
534  }
535 
536  }
537  }
538 
539  return true;
540 }
Class ZONE_CONTAINER handles a list of polygons defining a copper zone.
Definition: class_zone.h:78
VECTOR2I & B
Definition: seg.h:52
SEGMENT_ITERATOR IterateSegmentsWithHoles()
Returns an iterator object, for all outlines in the set (with holes)
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
SHAPE_POLY_SET * Outline()
Definition: class_zone.h:247
#define COPPERAREA_CLOSE_TO_COPPERAREA
copper area outlines are too close
Definition: drc_stuff.h:62
Struct VERTEX_INDEX.
Class SEGMENT_ITERATOR_TEMPLATE.
int GetClearanceBetweenSegments(int x1i, int y1i, int x1f, int y1f, int w1, int x2i, int y2i, int x2f, int y2f, int w2, int max_cl, int *x, int *y)
LAYER_ID GetLayer() const
Function GetLayer returns the primary layer this item is on.
BOARD * m_pcb
Definition: drc_stuff.h:205
bool GetIsKeepout() const
Accessors to parameters used in Keepout zones:
Definition: class_zone.h:644
VECTOR2I & A
Definition: seg.h:51
bool GetRelativeIndices(int aGlobalIdx, VERTEX_INDEX *aRelativeIndices) const
Function GetRelativeIndices.
int GetAreaCount() const
Function GetAreaCount.
Definition: class_board.h:1051
int GetNetCode() const
Function GetNetCode.
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
Definition: seg.h:37
SEG Segment(int aIndex)
Function Segment()
bool IsOnCopperLayer() const
Function IsOnCopperLayer.
Definition: class_zone.h:179
ZONE_CONTAINER * GetArea(int index) const
Function GetArea returns the Area (Zone Container) at a given index.
Definition: class_board.h:1022
#define max(a, b)
Definition: auxiliary.h:86
Class SHAPE_LINE_CHAIN.
POLYGON & Polygon(int aIndex)
Returns the aIndex-th subpolygon in the set
unsigned GetPriority() const
Function GetPriority.
Definition: class_zone.h:119
int GetZoneClearance() const
Definition: class_zone.h:203
bool Contains(const VECTOR2I &aP, int aSubpolyIndex=-1) const
Returns true if a given subpolygon contains the point aP.
#define COPPERAREA_INSIDE_COPPERAREA
copper area outlines intersect
Definition: drc_stuff.h:61
bool DRC::doFootprintOverlappingDrc ( )
private

Function doFootprintOverlappingDrc tests for footprint courtyard overlaps.

Returns
bool - false if DRC error or true if OK

Definition at line 986 of file drc.cpp.

References addMarkerToPcb(), SHAPE_POLY_SET::Append(), SHAPE_POLY_SET::BooleanIntersection(), DRCE_MALFORMED_COURTYARD_IN_FOOTPRINT, DRCE_MISSING_COURTYARD_IN_FOOTPRINT, DRCE_OVERLAPPING_FOOTPRINTS, fillMarker(), m_currentMarker, m_doFootprintOverlapping, m_doNoCourtyardDefined, BOARD::m_Modules, m_pcb, MODULE::Next(), SHAPE_POLY_SET::OutlineCount(), SHAPE_POLY_SET::PM_FAST, SHAPE_POLY_SET::RemoveAllContours(), SHAPE_POLY_SET::Vertex(), VECTOR2< T >::x, and VECTOR2< T >::y.

Referenced by RunTests().

987 {
988  // Detects missing (or malformed) footprint courtyard,
989  // and for footprint with courtyard, courtyards overlap.
990  wxString msg;
991  bool success = true;
992 
993  // Update courtyard polygons, and test for missing courtyard definition:
994  for( MODULE* footprint = m_pcb->m_Modules; footprint; footprint = footprint->Next() )
995  {
996  bool is_ok = footprint->BuildPolyCourtyard();
997 
998  if( !is_ok && m_doFootprintOverlapping )
999  {
1000  msg.Printf( _( "footprint '%s' has malformed courtyard" ),
1001  footprint->GetReference().GetData() );
1002  m_currentMarker = fillMarker( footprint->GetPosition(),
1004  msg, m_currentMarker );
1006  m_currentMarker = nullptr;
1007  success = false;
1008  }
1009 
1010  if( !m_doNoCourtyardDefined )
1011  continue;
1012 
1013  if( footprint->GetPolyCourtyardFront().OutlineCount() == 0 &&
1014  footprint->GetPolyCourtyardBack().OutlineCount() == 0 &&
1015  is_ok )
1016  {
1017  msg.Printf( _( "footprint '%s' has no courtyard defined" ),
1018  footprint->GetReference().GetData() );
1019  m_currentMarker = fillMarker( footprint->GetPosition(),
1021  msg, m_currentMarker );
1023  m_currentMarker = nullptr;
1024  success = false;
1025  }
1026  }
1027 
1029  return success;
1030 
1031  // Now test for overlapping on top layer:
1032  SHAPE_POLY_SET courtyard; // temporary storage of the courtyard of current footprint
1033 
1034  for( MODULE* footprint = m_pcb->m_Modules; footprint; footprint = footprint->Next() )
1035  {
1036  if( footprint->GetPolyCourtyardFront().OutlineCount() == 0 )
1037  continue; // No courtyard defined
1038 
1039  for( MODULE* candidate = footprint->Next(); candidate; candidate = candidate->Next() )
1040  {
1041  if( candidate->GetPolyCourtyardFront().OutlineCount() == 0 )
1042  continue; // No courtyard defined
1043 
1044  courtyard.RemoveAllContours();
1045  courtyard.Append( footprint->GetPolyCourtyardFront() );
1046 
1047  // Build the common area between footprint and the candidate:
1048  courtyard.BooleanIntersection( candidate->GetPolyCourtyardFront(), SHAPE_POLY_SET::PM_FAST );
1049 
1050  // If no overlap, courtyard is empty (no common area).
1051  // Therefore if a common polygon exists, this is a DRC error
1052  if( courtyard.OutlineCount() )
1053  {
1054  //Overlap between footprint and candidate
1055  msg.Printf( _( "footprints '%s' and '%s' overlap on front (top) layer" ),
1056  footprint->GetReference().GetData(),
1057  candidate->GetReference().GetData() );
1058  VECTOR2I& pos = courtyard.Vertex( 0, 0, -1 );
1059  wxPoint loc( pos.x, pos.y );
1062  m_currentMarker = nullptr;
1063  success = false;
1064  }
1065  }
1066  }
1067 
1068  // Test for overlapping on bottom layer:
1069  for( MODULE* footprint = m_pcb->m_Modules; footprint; footprint = footprint->Next() )
1070  {
1071  if( footprint->GetPolyCourtyardBack().OutlineCount() == 0 )
1072  continue; // No courtyard defined
1073 
1074  for( MODULE* candidate = footprint->Next(); candidate; candidate = candidate->Next() )
1075  {
1076  if( candidate->GetPolyCourtyardBack().OutlineCount() == 0 )
1077  continue; // No courtyard defined
1078 
1079  courtyard.RemoveAllContours();
1080  courtyard.Append( footprint->GetPolyCourtyardBack() );
1081 
1082  // Build the common area between footprint and the candidate:
1083  courtyard.BooleanIntersection( candidate->GetPolyCourtyardBack(), SHAPE_POLY_SET::PM_FAST );
1084 
1085  // If no overlap, courtyard is empty (no common area).
1086  // Therefore if a common polygon exists, this is a DRC error
1087  if( courtyard.OutlineCount() )
1088  {
1089  //Overlap between footprint and candidate
1090  msg.Printf( _( "footprints '%s' and '%s' overlap on back (bottom) layer" ),
1091  footprint->GetReference().GetData(),
1092  candidate->GetReference().GetData() );
1093  VECTOR2I& pos = courtyard.Vertex( 0, 0, -1 );
1094  wxPoint loc( pos.x, pos.y );
1097  m_currentMarker = nullptr;
1098  success = false;
1099  }
1100  }
1101  }
1102 
1103  return success;
1104 }
bool m_doNoCourtyardDefined
Definition: drc_stuff.h:172
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
MODULE * Next() const
Definition: class_module.h:99
#define DRCE_MISSING_COURTYARD_IN_FOOTPRINT
footprint has no courtyard defined
Definition: drc_stuff.h:84
int OutlineCount() const
Returns the number of outlines in the set
BOARD * m_pcb
Definition: drc_stuff.h:205
bool m_doFootprintOverlapping
Definition: drc_stuff.h:171
VECTOR2I & Vertex(int aIndex, int aOutline, int aHole)
Returns the index-th vertex in a given hole outline within a given outline
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
Class SHAPE_POLY_SET.
void BooleanIntersection(const SHAPE_POLY_SET &b, POLYGON_MODE aFastMode)
Performs boolean polyset intersection For aFastMode meaning, see function booleanOp ...
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
#define DRCE_OVERLAPPING_FOOTPRINTS
footprint courtyards overlap
Definition: drc_stuff.h:83
DLIST< MODULE > m_Modules
Definition: class_board.h:243
#define DRCE_MALFORMED_COURTYARD_IN_FOOTPRINT
footprint has a courtyard but malformed
Definition: drc_stuff.h:85
void RemoveAllContours()
Removes all outlines & holes (clears) the polygon set.
int Append(int x, int y, int aOutline=-1, int aHole=-1, bool aAllowDuplication=false)
Appends a vertex at the end of the given outline/hole (default: the last outline) ...
bool DRC::doNetClass ( std::shared_ptr< NETCLASS aNetClass,
wxString &  msg 
)
private

Definition at line 350 of file drc.cpp.

References addMarkerToPcb(), DRCE_NETCLASS_CLEARANCE, DRCE_NETCLASS_TRACKWIDTH, DRCE_NETCLASS_uVIADRILLSIZE, DRCE_NETCLASS_uVIASIZE, DRCE_NETCLASS_VIADRILLSIZE, DRCE_NETCLASS_VIASIZE, fillMarker(), FmtVal, GetChars(), BOARD::GetDesignSettings(), m_currentMarker, BOARD_DESIGN_SETTINGS::m_MicroViasMinDrill, BOARD_DESIGN_SETTINGS::m_MicroViasMinSize, m_pcb, BOARD_DESIGN_SETTINGS::m_TrackMinWidth, BOARD_DESIGN_SETTINGS::m_ViasMinDrill, and BOARD_DESIGN_SETTINGS::m_ViasMinSize.

Referenced by testNetClasses().

351 {
352  bool ret = true;
353 
355 
356 #define FmtVal( x ) GetChars( StringFromValue( g_UserUnit, x ) )
357 
358 #if 0 // set to 1 when (if...) BOARD_DESIGN_SETTINGS has a m_MinClearance value
359  if( nc->GetClearance() < g.m_MinClearance )
360  {
361  msg.Printf( _( "NETCLASS: '%s' has Clearance:%s which is less than global:%s" ),
362  GetChars( nc->GetName() ),
363  FmtVal( nc->GetClearance() ),
364  FmtVal( g.m_TrackClearance )
365  );
366 
368  m_currentMarker = nullptr;
369  ret = false;
370  }
371 #endif
372 
373  if( nc->GetTrackWidth() < g.m_TrackMinWidth )
374  {
375  msg.Printf( _( "NETCLASS: '%s' has TrackWidth:%s which is less than global:%s" ),
376  GetChars( nc->GetName() ),
377  FmtVal( nc->GetTrackWidth() ),
379  );
380 
382  m_currentMarker = nullptr;
383  ret = false;
384  }
385 
386  if( nc->GetViaDiameter() < g.m_ViasMinSize )
387  {
388  msg.Printf( _( "NETCLASS: '%s' has Via Dia:%s which is less than global:%s" ),
389  GetChars( nc->GetName() ),
390  FmtVal( nc->GetViaDiameter() ),
391  FmtVal( g.m_ViasMinSize )
392  );
393 
395  m_currentMarker = nullptr;
396  ret = false;
397  }
398 
399  if( nc->GetViaDrill() < g.m_ViasMinDrill )
400  {
401  msg.Printf( _( "NETCLASS: '%s' has Via Drill:%s which is less than global:%s" ),
402  GetChars( nc->GetName() ),
403  FmtVal( nc->GetViaDrill() ),
405  );
406 
408  m_currentMarker = nullptr;
409  ret = false;
410  }
411 
412  if( nc->GetuViaDiameter() < g.m_MicroViasMinSize )
413  {
414  msg.Printf( _( "NETCLASS: '%s' has uVia Dia:%s which is less than global:%s" ),
415  GetChars( nc->GetName() ),
416  FmtVal( nc->GetuViaDiameter() ),
418  );
419 
421  m_currentMarker = nullptr;
422  ret = false;
423  }
424 
425  if( nc->GetuViaDrill() < g.m_MicroViasMinDrill )
426  {
427  msg.Printf( _( "NETCLASS: '%s' has uVia Drill:%s which is less than global:%s" ),
428  GetChars( nc->GetName() ),
429  FmtVal( nc->GetuViaDrill() ),
431  );
432 
434  m_currentMarker = nullptr;
435  ret = false;
436  }
437 
438  return ret;
439 }
#define DRCE_NETCLASS_CLEARANCE
netclass has Clearance < board.m_designSettings->m_TrackClearance
Definition: drc_stuff.h:72
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
BOARD * m_pcb
Definition: drc_stuff.h:205
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
#define DRCE_NETCLASS_uVIADRILLSIZE
netclass has ViaSize < board.m_designSettings->m_MicroViasMinDrill
Definition: drc_stuff.h:76
int m_TrackMinWidth
track min value for width ((min copper size value
int m_ViasMinSize
vias (not micro vias) min diameter
int m_ViasMinDrill
vias (not micro vias) min drill diameter
BOARD_DESIGN_SETTINGS & GetDesignSettings() const
Function GetDesignSettings.
Definition: class_board.h:530
int m_MicroViasMinSize
micro vias (not vias) min diameter
#define FmtVal(x)
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
#define DRCE_NETCLASS_uVIASIZE
netclass has ViaSize < board.m_designSettings->m_MicroViasMinSize
Definition: drc_stuff.h:75
static const wxChar * GetChars(const wxString &s)
Function GetChars returns a wxChar* to the actual wxChar* data within a wxString, and is helpful for ...
Definition: macros.h:92
#define DRCE_NETCLASS_TRACKWIDTH
netclass has TrackWidth < board.m_designSettings->m_TrackMinWidth
Definition: drc_stuff.h:71
#define DRCE_NETCLASS_VIASIZE
netclass has ViaSize < board.m_designSettings->m_ViasMinSize
Definition: drc_stuff.h:73
int m_MicroViasMinDrill
micro vias (not vias) min drill diameter
Class BOARD_DESIGN_SETTINGS contains design settings for a BOARD object.
#define DRCE_NETCLASS_VIADRILLSIZE
netclass has ViaDrillSize < board.m_designSettings->m_ViasMinDrill
Definition: drc_stuff.h:74
bool DRC::doPadToPadsDrc ( D_PAD aRefPad,
D_PAD **  aStart,
D_PAD **  aEnd,
int  x_limit 
)
private

Function doPadToPadsDrc tests the clearance between aRefPad and other pads.

The pad list must be sorted by x coordinate.

Parameters
aRefPadThe pad to test
aStartThe start of the pad list to test against
aEndMarks the end of the list and is not included
x_limitis used to stop the test (when the any pad's X coord exceeds this)

Definition at line 852 of file drc.cpp.

References LSET::AllCuMask(), checkClearancePadToPad(), DRCE_HOLE_NEAR_PAD, DRCE_PAD_NEAR_PAD1, fillMarker(), D_PAD::GetDrillShape(), D_PAD::GetDrillSize(), D_PAD::GetLayerSet(), BOARD_CONNECTED_ITEM::GetNetCode(), D_PAD::GetOrientation(), D_PAD::GetParent(), D_PAD::GetPosition(), m_currentMarker, m_pcb, PAD_DRILL_SHAPE_CIRCLE, PAD_DRILL_SHAPE_OBLONG, PAD_SHAPE_CIRCLE, PAD_SHAPE_OVAL, D_PAD::PadNameEqual(), D_PAD::SetLayerSet(), D_PAD::SetLocalClearance(), D_PAD::SetOrientation(), D_PAD::SetPosition(), D_PAD::SetShape(), D_PAD::SetSize(), and wxPoint::x.

Referenced by testPad2Pad().

853 {
854  const static LSET all_cu = LSET::AllCuMask();
855 
856  LSET layerMask = aRefPad->GetLayerSet() & all_cu;
857 
858  /* used to test DRC pad to holes: this dummy pad has the size and shape of the hole
859  * to test pad to pad hole DRC, using the pad to pad DRC test function.
860  * Therefore, this dummy pad is a circle or an oval.
861  * A pad must have a parent because some functions expect a non null parent
862  * to find the parent board, and some other data
863  */
864  MODULE dummymodule( m_pcb ); // Creates a dummy parent
865  D_PAD dummypad( &dummymodule );
866 
867  // Ensure the hole is on all copper layers
868  dummypad.SetLayerSet( all_cu | dummypad.GetLayerSet() );
869 
870  // Use the minimal local clearance value for the dummy pad.
871  // The clearance of the active pad will be used as minimum distance to a hole
872  // (a value = 0 means use netclass value)
873  dummypad.SetLocalClearance( 1 );
874 
875  for( D_PAD** pad_list = aStart; pad_list<aEnd; ++pad_list )
876  {
877  D_PAD* pad = *pad_list;
878 
879  if( pad == aRefPad )
880  continue;
881 
882  // We can stop the test when pad->GetPosition().x > x_limit
883  // because the list is sorted by X values
884  if( pad->GetPosition().x > x_limit )
885  break;
886 
887  // No problem if pads which are on copper layers are on different copper layers,
888  // (pads can be only on a technical layer, to build complex pads)
889  // but their hole (if any ) can create DRC error because they are on all
890  // copper layers, so we test them
891  if( ( pad->GetLayerSet() & layerMask ) == 0 &&
892  ( pad->GetLayerSet() & all_cu ) != 0 &&
893  ( aRefPad->GetLayerSet() & all_cu ) != 0 )
894  {
895  // if holes are in the same location and have the same size and shape,
896  // this can be accepted
897  if( pad->GetPosition() == aRefPad->GetPosition()
898  && pad->GetDrillSize() == aRefPad->GetDrillSize()
899  && pad->GetDrillShape() == aRefPad->GetDrillShape() )
900  {
901  if( aRefPad->GetDrillShape() == PAD_DRILL_SHAPE_CIRCLE )
902  continue;
903 
904  // for oval holes: must also have the same orientation
905  if( pad->GetOrientation() == aRefPad->GetOrientation() )
906  continue;
907  }
908 
909  /* Here, we must test clearance between holes and pads
910  * dummy pad size and shape is adjusted to pad drill size and shape
911  */
912  if( pad->GetDrillSize().x )
913  {
914  // pad under testing has a hole, test this hole against pad reference
915  dummypad.SetPosition( pad->GetPosition() );
916  dummypad.SetSize( pad->GetDrillSize() );
917  dummypad.SetShape( pad->GetDrillShape() == PAD_DRILL_SHAPE_OBLONG ?
919  dummypad.SetOrientation( pad->GetOrientation() );
920 
921  if( !checkClearancePadToPad( aRefPad, &dummypad ) )
922  {
923  // here we have a drc error on pad!
924  m_currentMarker = fillMarker( pad, aRefPad,
926  return false;
927  }
928  }
929 
930  if( aRefPad->GetDrillSize().x ) // pad reference has a hole
931  {
932  dummypad.SetPosition( aRefPad->GetPosition() );
933  dummypad.SetSize( aRefPad->GetDrillSize() );
934  dummypad.SetShape( aRefPad->GetDrillShape() == PAD_DRILL_SHAPE_OBLONG ?
936  dummypad.SetOrientation( aRefPad->GetOrientation() );
937 
938  if( !checkClearancePadToPad( pad, &dummypad ) )
939  {
940  // here we have a drc error on aRefPad!
941  m_currentMarker = fillMarker( aRefPad, pad,
943  return false;
944  }
945  }
946 
947  continue;
948  }
949 
950  // The pad must be in a net (i.e pt_pad->GetNet() != 0 ),
951  // But no problem if pads have the same netcode (same net)
952  if( pad->GetNetCode() && ( aRefPad->GetNetCode() == pad->GetNetCode() ) )
953  continue;
954 
955  // if pads are from the same footprint
956  if( pad->GetParent() == aRefPad->GetParent() )
957  {
958  // and have the same pad number ( equivalent pads )
959 
960  // one can argue that this 2nd test is not necessary, that any
961  // two pads from a single module are acceptable. This 2nd test
962  // should eventually be a configuration option.
963  if( pad->PadNameEqual( aRefPad ) )
964  continue;
965  }
966 
967  // if either pad has no drill and is only on technical layers, not a clearance violation
968  if( ( ( pad->GetLayerSet() & layerMask ) == 0 && !pad->GetDrillSize().x ) ||
969  ( ( aRefPad->GetLayerSet() & layerMask ) == 0 && !aRefPad->GetDrillSize().x ) )
970  {
971  continue;
972  }
973 
974  if( !checkClearancePadToPad( aRefPad, pad ) )
975  {
976  // here we have a drc error!
978  return false;
979  }
980  }
981 
982  return true;
983 }
static LSET AllCuMask(int aCuLayerCount=MAX_CU_LAYERS)
Function AllCuMask returns a mask holding the requested number of Cu LAYER_IDs.
Definition: lset.cpp:638
bool PadNameEqual(const D_PAD *other) const
Definition: class_pad.h:157
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
#define DRCE_PAD_NEAR_PAD1
pad too close to pad
Definition: drc_stuff.h:58
MODULE * GetParent() const
Definition: class_pad.h:108
void SetPosition(const wxPoint &aPos) override
Definition: class_pad.h:169
PAD_DRILL_SHAPE_T GetDrillShape() const
Definition: class_pad.h:221
const wxSize & GetDrillSize() const
Definition: class_pad.h:188
BOARD * m_pcb
Definition: drc_stuff.h:205
Class LSET is a set of LAYER_IDs.
const wxPoint & GetPosition() const override
Definition: class_pad.h:170
LSET GetLayerSet() const override
Function GetLayerSet returns a "layer mask", which is a bitmap of all layers on which the TRACK segme...
Definition: class_pad.h:235
int GetNetCode() const
Function GetNetCode.
bool checkClearancePadToPad(D_PAD *aRefPad, D_PAD *aPad)
Function checkClearancePadToPad.
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
double GetOrientation() const
Function GetOrientation returns the rotation angle of the pad in tenths of degrees, but soon degrees.
Definition: class_pad.h:214
#define DRCE_HOLE_NEAR_PAD
hole too close to pad
Definition: drc_stuff.h:64
bool DRC::doTrackDrc ( TRACK aRefSeg,
TRACK aStart,
bool  doPads = true 
)
private

Function DoTrackDrc tests the current segment.

Parameters
aRefSegThe segment to test
aStartThe head of a list of tracks to test against (usually BOARD::m_Track)
doPadstrue if should do pads test
Returns
bool - true if no poblems, else false and m_currentMarker is filled in with the problem information.

Definition at line 137 of file drc_clearance_test_functions.cpp.

References abs, LSET::AllCuMask(), PNS::angle(), ArcTangente(), B_Cu, checkClearanceSegmToPad(), checkLine(), checkMarginToCircle(), delta, DRCE_ENDS_PROBLEM1, DRCE_ENDS_PROBLEM2, DRCE_ENDS_PROBLEM3, DRCE_ENDS_PROBLEM4, DRCE_ENDS_PROBLEM5, DRCE_MICRO_VIA_INCORRECT_LAYER_PAIR, DRCE_TOO_SMALL_MICROVIA, DRCE_TOO_SMALL_MICROVIA_DRILL, DRCE_TOO_SMALL_TRACK_WIDTH, DRCE_TOO_SMALL_VIA, DRCE_TOO_SMALL_VIA_DRILL, DRCE_TRACK_ENDS1, DRCE_TRACK_ENDS2, DRCE_TRACK_ENDS3, DRCE_TRACK_ENDS4, DRCE_TRACK_NEAR_PAD, DRCE_TRACK_NEAR_THROUGH_HOLE, DRCE_TRACK_NEAR_VIA, DRCE_TRACK_SEGMENTS_TOO_CLOSE, DRCE_TRACKS_CROSSING, DRCE_VIA_HOLE_BIGGER, DRCE_VIA_NEAR_TRACK, DRCE_VIA_NEAR_VIA, EuclideanNorm(), F_Cu, fillMarker(), TRACK::GetClearance(), BOARD_DESIGN_SETTINGS::GetCopperLayerCount(), BOARD::GetDesignSettings(), D_PAD::GetDrillShape(), D_PAD::GetDrillSize(), VIA::GetDrillValue(), TRACK::GetEnd(), BOARD_ITEM::GetLayerSet(), D_PAD::GetLayerSet(), BOARD_CONNECTED_ITEM::GetNetClass(), BOARD_CONNECTED_ITEM::GetNetCode(), D_PAD::GetOrientation(), BOARD::GetPad(), BOARD::GetPadCount(), D_PAD::GetPosition(), TRACK::GetStart(), VIA::GetViaType(), TRACK::GetWidth(), In1_Cu, VIA::LayerPair(), m_currentMarker, BOARD_DESIGN_SETTINGS::m_MicroViasMinDrill, BOARD_DESIGN_SETTINGS::m_MicroViasMinSize, m_padToTestPos, m_pcb, m_segmAngle, m_segmEnd, m_segmLength, BOARD_DESIGN_SETTINGS::m_TrackMinWidth, BOARD_DESIGN_SETTINGS::m_ViasMinDrill, BOARD_DESIGN_SETTINGS::m_ViasMinSize, m_xcliphi, m_xcliplo, m_ycliphi, m_ycliplo, TRACK::Next(), PAD_DRILL_SHAPE_OBLONG, PAD_SHAPE_CIRCLE, PAD_SHAPE_OVAL, PCB_VIA_T, RotatePoint(), D_PAD::SetLayerSet(), D_PAD::SetOrientation(), D_PAD::SetPosition(), D_PAD::SetShape(), D_PAD::SetSize(), D_PAD::ShapePos(), EDA_ITEM::Type(), VIA_MICROVIA, wxPoint::x, and wxPoint::y.

Referenced by Drc(), DrcBlind(), and testTracks().

138 {
139  TRACK* track;
140  wxPoint delta; // length on X and Y axis of segments
141  LSET layerMask;
142  int net_code_ref;
143  wxPoint shape_pos;
144 
145  NETCLASSPTR netclass = aRefSeg->GetNetClass();
147 
148  /* In order to make some calculations more easier or faster,
149  * pads and tracks coordinates will be made relative to the reference segment origin
150  */
151  wxPoint origin = aRefSeg->GetStart(); // origin will be the origin of other coordinates
152 
153  m_segmEnd = delta = aRefSeg->GetEnd() - origin;
154  m_segmAngle = 0;
155 
156  layerMask = aRefSeg->GetLayerSet();
157  net_code_ref = aRefSeg->GetNetCode();
158 
159  // Phase 0 : Test vias
160  if( aRefSeg->Type() == PCB_VIA_T )
161  {
162  const VIA *refvia = static_cast<const VIA*>( aRefSeg );
163  // test if the via size is smaller than minimum
164  if( refvia->GetViaType() == VIA_MICROVIA )
165  {
166  if( refvia->GetWidth() < dsnSettings.m_MicroViasMinSize )
167  {
168  m_currentMarker = fillMarker( refvia, NULL,
170  return false;
171  }
172  if( refvia->GetDrillValue() < dsnSettings.m_MicroViasMinDrill )
173  {
174  m_currentMarker = fillMarker( refvia, NULL,
176  return false;
177  }
178  }
179  else
180  {
181  if( refvia->GetWidth() < dsnSettings.m_ViasMinSize )
182  {
183  m_currentMarker = fillMarker( refvia, NULL,
185  return false;
186  }
187  if( refvia->GetDrillValue() < dsnSettings.m_ViasMinDrill )
188  {
189  m_currentMarker = fillMarker( refvia, NULL,
191  return false;
192  }
193  }
194 
195  // test if via's hole is bigger than its diameter
196  // This test is necessary since the via hole size and width can be modified
197  // and a default via hole can be bigger than some vias sizes
198  if( refvia->GetDrillValue() > refvia->GetWidth() )
199  {
200  m_currentMarker = fillMarker( refvia, NULL,
202  return false;
203  }
204 
205  // For microvias: test if they are blind vias and only between 2 layers
206  // because they are used for very small drill size and are drill by laser
207  // and **only one layer** can be drilled
208  if( refvia->GetViaType() == VIA_MICROVIA )
209  {
210  LAYER_ID layer1, layer2;
211  bool err = true;
212 
213  refvia->LayerPair( &layer1, &layer2 );
214 
215  if( layer1 > layer2 )
216  std::swap( layer1, layer2 );
217 
218  if( layer2 == B_Cu && layer1 == m_pcb->GetDesignSettings().GetCopperLayerCount() - 2 )
219  err = false;
220  else if( layer1 == F_Cu && layer2 == In1_Cu )
221  err = false;
222 
223  if( err )
224  {
225  m_currentMarker = fillMarker( refvia, NULL,
227  return false;
228  }
229  }
230  }
231  else // This is a track segment
232  {
233  if( aRefSeg->GetWidth() < dsnSettings.m_TrackMinWidth )
234  {
235  m_currentMarker = fillMarker( aRefSeg, NULL,
237  return false;
238  }
239  }
240 
241  // for a non horizontal or vertical segment Compute the segment angle
242  // in tenths of degrees and its length
243  if( delta.x || delta.y )
244  {
245  // Compute the segment angle in 0,1 degrees
246  m_segmAngle = ArcTangente( delta.y, delta.x );
247 
248  // Compute the segment length: we build an equivalent rotated segment,
249  // this segment is horizontal, therefore dx = length
250  RotatePoint( &delta, m_segmAngle ); // delta.x = length, delta.y = 0
251  }
252 
253  m_segmLength = delta.x;
254 
255  /******************************************/
256  /* Phase 1 : test DRC track to pads : */
257  /******************************************/
258 
259  /* Use a dummy pad to test DRC tracks versus holes, for pads not on all copper layers
260  * but having a hole
261  * This dummy pad has the size and shape of the hole
262  * to test tracks to pad hole DRC, using checkClearanceSegmToPad test function.
263  * Therefore, this dummy pad is a circle or an oval.
264  * A pad must have a parent because some functions expect a non null parent
265  * to find the parent board, and some other data
266  */
267  MODULE dummymodule( m_pcb ); // Creates a dummy parent
268  D_PAD dummypad( &dummymodule );
269 
270  dummypad.SetLayerSet( LSET::AllCuMask() ); // Ensure the hole is on all layers
271 
272  // Compute the min distance to pads
273  if( testPads )
274  {
275  unsigned pad_count = m_pcb->GetPadCount();
276 
277  for( unsigned ii = 0; ii<pad_count; ++ii )
278  {
279  D_PAD* pad = m_pcb->GetPad( ii );
280 
281  /* No problem if pads are on an other layer,
282  * But if a drill hole exists (a pad on a single layer can have a hole!)
283  * we must test the hole
284  */
285  if( !( pad->GetLayerSet() & layerMask ).any() )
286  {
287  /* We must test the pad hole. In order to use the function
288  * checkClearanceSegmToPad(),a pseudo pad is used, with a shape and a
289  * size like the hole
290  */
291  if( pad->GetDrillSize().x == 0 )
292  continue;
293 
294  dummypad.SetSize( pad->GetDrillSize() );
295  dummypad.SetPosition( pad->GetPosition() );
296  dummypad.SetShape( pad->GetDrillShape() == PAD_DRILL_SHAPE_OBLONG ?
298  dummypad.SetOrientation( pad->GetOrientation() );
299 
300  m_padToTestPos = dummypad.GetPosition() - origin;
301 
302  if( !checkClearanceSegmToPad( &dummypad, aRefSeg->GetWidth(),
303  netclass->GetClearance() ) )
304  {
305  m_currentMarker = fillMarker( aRefSeg, pad,
307  return false;
308  }
309 
310  continue;
311  }
312 
313  // The pad must be in a net (i.e pt_pad->GetNet() != 0 )
314  // but no problem if the pad netcode is the current netcode (same net)
315  if( pad->GetNetCode() // the pad must be connected
316  && net_code_ref == pad->GetNetCode() ) // the pad net is the same as current net -> Ok
317  continue;
318 
319  // DRC for the pad
320  shape_pos = pad->ShapePos();
321  m_padToTestPos = shape_pos - origin;
322 
323  if( !checkClearanceSegmToPad( pad, aRefSeg->GetWidth(), aRefSeg->GetClearance( pad ) ) )
324  {
325  m_currentMarker = fillMarker( aRefSeg, pad,
327  return false;
328  }
329  }
330  }
331 
332  /***********************************************/
333  /* Phase 2: test DRC with other track segments */
334  /***********************************************/
335 
336  // At this point the reference segment is the X axis
337 
338  // Test the reference segment with other track segments
339  wxPoint segStartPoint;
340  wxPoint segEndPoint;
341  for( track = aStart; track; track = track->Next() )
342  {
343  // No problem if segments have the same net code:
344  if( net_code_ref == track->GetNetCode() )
345  continue;
346 
347  // No problem if segment are on different layers :
348  if( !( layerMask & track->GetLayerSet() ).any() )
349  continue;
350 
351  // the minimum distance = clearance plus half the reference track
352  // width plus half the other track's width
353  int w_dist = aRefSeg->GetClearance( track );
354  w_dist += (aRefSeg->GetWidth() + track->GetWidth()) / 2;
355 
356  // Due to many double to int conversions during calculations, which
357  // create rounding issues,
358  // the exact clearance margin cannot be really known.
359  // To avoid false bad DRC detection due to these rounding issues,
360  // slightly decrease the w_dist (remove one nanometer is enough !)
361  w_dist -= 1;
362 
363  // If the reference segment is a via, we test it here
364  if( aRefSeg->Type() == PCB_VIA_T )
365  {
366  delta = track->GetEnd() - track->GetStart();
367  segStartPoint = aRefSeg->GetStart() - track->GetStart();
368 
369  if( track->Type() == PCB_VIA_T )
370  {
371  // Test distance between two vias, i.e. two circles, trivial case
372  if( EuclideanNorm( segStartPoint ) < w_dist )
373  {
374  m_currentMarker = fillMarker( aRefSeg, track,
376  return false;
377  }
378  }
379  else // test via to segment
380  {
381  // Compute l'angle du segment a tester;
382  double angle = ArcTangente( delta.y, delta.x );
383 
384  // Compute new coordinates ( the segment become horizontal)
385  RotatePoint( &delta, angle );
386  RotatePoint( &segStartPoint, angle );
387 
388  if( !checkMarginToCircle( segStartPoint, w_dist, delta.x ) )
389  {
390  m_currentMarker = fillMarker( track, aRefSeg,
392  return false;
393  }
394  }
395 
396  continue;
397  }
398 
399  /* We compute segStartPoint, segEndPoint = starting and ending point coordinates for
400  * the segment to test in the new axis : the new X axis is the
401  * reference segment. We must translate and rotate the segment to test
402  */
403  segStartPoint = track->GetStart() - origin;
404  segEndPoint = track->GetEnd() - origin;
405  RotatePoint( &segStartPoint, m_segmAngle );
406  RotatePoint( &segEndPoint, m_segmAngle );
407  if( track->Type() == PCB_VIA_T )
408  {
409  if( checkMarginToCircle( segStartPoint, w_dist, m_segmLength ) )
410  continue;
411 
412  m_currentMarker = fillMarker( aRefSeg, track,
414  return false;
415  }
416 
417  /* We have changed axis:
418  * the reference segment is Horizontal.
419  * 3 cases : the segment to test can be parallel, perpendicular or have an other direction
420  */
421  if( segStartPoint.y == segEndPoint.y ) // parallel segments
422  {
423  if( abs( segStartPoint.y ) >= w_dist )
424  continue;
425 
426  // Ensure segStartPoint.x <= segEndPoint.x
427  if( segStartPoint.x > segEndPoint.x )
428  std::swap( segStartPoint.x, segEndPoint.x );
429 
430  if( segStartPoint.x > (-w_dist) && segStartPoint.x < (m_segmLength + w_dist) ) /* possible error drc */
431  {
432  // the start point is inside the reference range
433  // X........
434  // O--REF--+
435 
436  // Fine test : we consider the rounded shape of each end of the track segment:
437  if( segStartPoint.x >= 0 && segStartPoint.x <= m_segmLength )
438  {
439  m_currentMarker = fillMarker( aRefSeg, track,
441  return false;
442  }
443 
444  if( !checkMarginToCircle( segStartPoint, w_dist, m_segmLength ) )
445  {
446  m_currentMarker = fillMarker( aRefSeg, track,
448  return false;
449  }
450  }
451 
452  if( segEndPoint.x > (-w_dist) && segEndPoint.x < (m_segmLength + w_dist) )
453  {
454  // the end point is inside the reference range
455  // .....X
456  // O--REF--+
457  // Fine test : we consider the rounded shape of the ends
458  if( segEndPoint.x >= 0 && segEndPoint.x <= m_segmLength )
459  {
460  m_currentMarker = fillMarker( aRefSeg, track,
462  return false;
463  }
464 
465  if( !checkMarginToCircle( segEndPoint, w_dist, m_segmLength ) )
466  {
467  m_currentMarker = fillMarker( aRefSeg, track,
469  return false;
470  }
471  }
472 
473  if( segStartPoint.x <=0 && segEndPoint.x >= 0 )
474  {
475  // the segment straddles the reference range (this actually only
476  // checks if it straddles the origin, because the other cases where already
477  // handled)
478  // X.............X
479  // O--REF--+
480  m_currentMarker = fillMarker( aRefSeg, track,
482  return false;
483  }
484  }
485  else if( segStartPoint.x == segEndPoint.x ) // perpendicular segments
486  {
487  if( ( segStartPoint.x <= (-w_dist) ) || ( segStartPoint.x >= (m_segmLength + w_dist) ) )
488  continue;
489 
490  // Test if segments are crossing
491  if( segStartPoint.y > segEndPoint.y )
492  std::swap( segStartPoint.y, segEndPoint.y );
493 
494  if( (segStartPoint.y < 0) && (segEndPoint.y > 0) )
495  {
496  m_currentMarker = fillMarker( aRefSeg, track,
498  return false;
499  }
500 
501  // At this point the drc error is due to an end near a reference segm end
502  if( !checkMarginToCircle( segStartPoint, w_dist, m_segmLength ) )
503  {
504  m_currentMarker = fillMarker( aRefSeg, track,
506  return false;
507  }
508  if( !checkMarginToCircle( segEndPoint, w_dist, m_segmLength ) )
509  {
510  m_currentMarker = fillMarker( aRefSeg, track,
512  return false;
513  }
514  }
515  else // segments quelconques entre eux
516  {
517  // calcul de la "surface de securite du segment de reference
518  // First rought 'and fast) test : the track segment is like a rectangle
519 
520  m_xcliplo = m_ycliplo = -w_dist;
521  m_xcliphi = m_segmLength + w_dist;
522  m_ycliphi = w_dist;
523 
524  // A fine test is needed because a serment is not exactly a
525  // rectangle, it has rounded ends
526  if( !checkLine( segStartPoint, segEndPoint ) )
527  {
528  /* 2eme passe : the track has rounded ends.
529  * we must a fine test for each rounded end and the
530  * rectangular zone
531  */
532 
533  m_xcliplo = 0;
535 
536  if( !checkLine( segStartPoint, segEndPoint ) )
537  {
538  m_currentMarker = fillMarker( aRefSeg, track,
540  return false;
541  }
542  else // The drc error is due to the starting or the ending point of the reference segment
543  {
544  // Test the starting and the ending point
545  segStartPoint = track->GetStart();
546  segEndPoint = track->GetEnd();
547  delta = segEndPoint - segStartPoint;
548 
549  // Compute the segment orientation (angle) en 0,1 degre
550  double angle = ArcTangente( delta.y, delta.x );
551 
552  // Compute the segment length: delta.x = length after rotation
553  RotatePoint( &delta, angle );
554 
555  /* Comute the reference segment coordinates relatives to a
556  * X axis = current tested segment
557  */
558  wxPoint relStartPos = aRefSeg->GetStart() - segStartPoint;
559  wxPoint relEndPos = aRefSeg->GetEnd() - segStartPoint;
560 
561  RotatePoint( &relStartPos, angle );
562  RotatePoint( &relEndPos, angle );
563 
564  if( !checkMarginToCircle( relStartPos, w_dist, delta.x ) )
565  {
566  m_currentMarker = fillMarker( aRefSeg, track,
568  return false;
569  }
570 
571  if( !checkMarginToCircle( relEndPos, w_dist, delta.x ) )
572  {
573  m_currentMarker = fillMarker( aRefSeg, track,
575  return false;
576  }
577  }
578  }
579  }
580  }
581 
582  return true;
583 }
double EuclideanNorm(const wxPoint &vector)
Euclidean norm of a 2D vector.
Definition: trigo.h:104
static LSET AllCuMask(int aCuLayerCount=MAX_CU_LAYERS)
Function AllCuMask returns a mask holding the requested number of Cu LAYER_IDs.
Definition: lset.cpp:638
KICAD_T Type() const
Function Type()
Definition: base_struct.h:198
#define DRCE_TRACK_SEGMENTS_TOO_CLOSE
2 parallel track segments too close: segm ends between segref ends
Definition: drc_stuff.h:51
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
int m_ycliplo
Definition: drc_stuff.h:200
#define DRCE_ENDS_PROBLEM1
track ends are too close
Definition: drc_stuff.h:53
#define DRCE_TRACK_ENDS1
2 parallel track segments too close: fine start point test
Definition: drc_stuff.h:47
#define DRCE_TOO_SMALL_MICROVIA_DRILL
Too small micro via drill.
Definition: drc_stuff.h:70
#define DRCE_TRACK_NEAR_VIA
track too close to via
Definition: drc_stuff.h:44
int m_ycliphi
Definition: drc_stuff.h:202
int m_segmLength
Definition: drc_stuff.h:194
PAD_DRILL_SHAPE_T GetDrillShape() const
Definition: class_pad.h:221
void RotatePoint(int *pX, int *pY, double angle)
Definition: trigo.cpp:317
const wxSize & GetDrillSize() const
Definition: class_pad.h:188
#define DRCE_TRACKS_CROSSING
tracks are crossing
Definition: drc_stuff.h:52
wxPoint m_padToTestPos
Definition: drc_stuff.h:185
#define DRCE_ENDS_PROBLEM2
track ends are too close
Definition: drc_stuff.h:54
#define abs(a)
Definition: auxiliary.h:84
#define DRCE_TOO_SMALL_MICROVIA
Too small micro via size.
Definition: drc_stuff.h:68
static const int delta[8][2]
Definition: solve.cpp:112
const wxPoint & GetEnd() const
Definition: class_track.h:117
BOARD * m_pcb
Definition: drc_stuff.h:205
bool checkLine(wxPoint aSegStart, wxPoint aSegEnd)
Function checkLine (helper function used in drc calculations to see if one track is in contact with a...
#define DRCE_ENDS_PROBLEM5
track ends are too close
Definition: drc_stuff.h:57
Class LSET is a set of LAYER_IDs.
int GetCopperLayerCount() const
Function GetCopperLayerCount.
VIATYPE_T GetViaType() const
Definition: class_track.h:442
double ArcTangente(int dy, int dx)
Definition: trigo.cpp:271
#define DRCE_VIA_NEAR_TRACK
via too close to track
Definition: drc_stuff.h:46
std::shared_ptr< NETCLASS > GetNetClass() const
Function GetNetClass returns the NETCLASS for this item.
const wxPoint & GetStart() const
Definition: class_track.h:120
const wxPoint & GetPosition() const override
Definition: class_pad.h:170
int m_TrackMinWidth
track min value for width ((min copper size value
int m_ViasMinSize
vias (not micro vias) min diameter
LSET GetLayerSet() const override
Function GetLayerSet returns a "layer mask", which is a bitmap of all layers on which the TRACK segme...
Definition: class_pad.h:235
int m_ViasMinDrill
vias (not micro vias) min drill diameter
virtual LSET GetLayerSet() const
Function GetLayerSet returns a "layer mask", which is a bitmap of all layers on which the TRACK segme...
BOARD_DESIGN_SETTINGS & GetDesignSettings() const
Function GetDesignSettings.
Definition: class_board.h:530
void SetSize(const wxSize &aSize)
Definition: class_pad.h:181
static bool checkMarginToCircle(wxPoint aCentre, int aRadius, int aLength)
Helper function checkMarginToCircle Check the distance from a point to a segment. ...
#define DRCE_TRACK_NEAR_PAD
pad too close to track
Definition: drc_stuff.h:43
virtual int GetClearance(BOARD_CONNECTED_ITEM *aItem=NULL) const override
Function GetClearance returns the clearance in internal units.
int m_xcliphi
Definition: drc_stuff.h:201
int m_MicroViasMinSize
micro vias (not vias) min diameter
D_PAD * GetPad(unsigned aIndex) const
Function GetPad.
Definition: class_board.h:750
unsigned GetPadCount() const
Function GetPadCount.
Definition: class_board.h:741
int GetNetCode() const
Function GetNetCode.
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
#define DRCE_TOO_SMALL_TRACK_WIDTH
Too small track width.
Definition: drc_stuff.h:66
bool checkClearanceSegmToPad(const D_PAD *aPad, int aSegmentWidth, int aMinDist)
Function checkClearanceSegmToPad check the distance from a pad to segment.
wxPoint m_segmEnd
Definition: drc_stuff.h:186
void LayerPair(LAYER_ID *top_layer, LAYER_ID *bottom_layer) const
Function LayerPair Return the 2 layers used by the via (the via actually uses all layers between thes...
TRACK * Next() const
Definition: class_track.h:97
int GetDrillValue() const
Function GetDrillValue "calculates" the drill value for vias (m-Drill if > 0, or default drill value ...
LAYER_ID
Enum LAYER_ID is the set of PCB layers.
int GetWidth() const
Definition: class_track.h:114
static DIRECTION_45::AngleType angle(const VECTOR2I &a, const VECTOR2I &b)
#define DRCE_ENDS_PROBLEM3
track ends are too close
Definition: drc_stuff.h:55
#define DRCE_TRACK_ENDS4
2 parallel track segments too close: fine end point test
Definition: drc_stuff.h:50
double GetOrientation() const
Function GetOrientation returns the rotation angle of the pad in tenths of degrees, but soon degrees.
Definition: class_pad.h:214
#define DRCE_VIA_NEAR_VIA
via too close to via
Definition: drc_stuff.h:45
wxPoint ShapePos() const
Definition: class_pad.cpp:367
class VIA, a via (like a track segment on a copper layer)
Definition: typeinfo.h:108
int m_MicroViasMinDrill
micro vias (not vias) min drill diameter
#define DRCE_TRACK_ENDS2
2 parallel track segments too close: fine start point test
Definition: drc_stuff.h:48
#define DRCE_TRACK_ENDS3
2 parallel track segments too close: fine end point test
Definition: drc_stuff.h:49
#define DRCE_ENDS_PROBLEM4
track ends are too close
Definition: drc_stuff.h:56
int m_xcliplo
Definition: drc_stuff.h:199
#define DRCE_MICRO_VIA_INCORRECT_LAYER_PAIR
micro via's layer pair incorrect (layers must be adjacent)
Definition: drc_stuff.h:60
double m_segmAngle
Definition: drc_stuff.h:193
#define DRCE_TRACK_NEAR_THROUGH_HOLE
thru hole is too close to track
Definition: drc_stuff.h:42
#define DRCE_VIA_HOLE_BIGGER
via's hole is bigger than its diameter
Definition: drc_stuff.h:59
Class BOARD_DESIGN_SETTINGS contains design settings for a BOARD object.
#define DRCE_TOO_SMALL_VIA_DRILL
Too small via drill.
Definition: drc_stuff.h:69
#define DRCE_TOO_SMALL_VIA
Too small via size.
Definition: drc_stuff.h:67
bool DRC::doTrackKeepoutDrc ( TRACK aRefSeg)
private

Function doTrackKeepoutDrc tests the current segment or via.

Parameters
aRefSegThe segment to test
Returns
bool - true if no poblems, else false and m_currentMarker is filled in with the problem information.

Definition at line 805 of file drc.cpp.

References SHAPE_POLY_SET::Distance(), DRCE_TRACK_INSIDE_KEEPOUT, DRCE_VIA_INSIDE_KEEPOUT, fillMarker(), BOARD::GetArea(), BOARD::GetAreaCount(), ZONE_CONTAINER::GetDoNotAllowTracks(), ZONE_CONTAINER::GetDoNotAllowVias(), TRACK::GetEnd(), ZONE_CONTAINER::GetIsKeepout(), BOARD_ITEM::GetLayer(), TRACK::GetPosition(), TRACK::GetStart(), TRACK::GetWidth(), m_currentMarker, m_pcb, ZONE_CONTAINER::Outline(), PCB_TRACE_T, PCB_VIA_T, and EDA_ITEM::Type().

Referenced by Drc(), and DrcBlind().

806 {
807  // Test keepout areas for vias, tracks and pads inside keepout areas
808  for( int ii = 0; ii < m_pcb->GetAreaCount(); ii++ )
809  {
810  ZONE_CONTAINER* area = m_pcb->GetArea( ii );
811 
812  if( !area->GetIsKeepout() )
813  continue;
814 
815  if( aRefSeg->Type() == PCB_TRACE_T )
816  {
817  if( ! area->GetDoNotAllowTracks() )
818  continue;
819 
820  if( aRefSeg->GetLayer() != area->GetLayer() )
821  continue;
822 
823  if( area->Outline()->Distance( SEG( aRefSeg->GetStart(), aRefSeg->GetEnd() ),
824  aRefSeg->GetWidth() ) == 0 )
825  {
826  m_currentMarker = fillMarker( aRefSeg, NULL,
828  return false;
829  }
830  }
831  else if( aRefSeg->Type() == PCB_VIA_T )
832  {
833  if( ! area->GetDoNotAllowVias() )
834  continue;
835 
836  if( ! ((VIA*)aRefSeg)->IsOnLayer( area->GetLayer() ) )
837  continue;
838 
839  if( area->Outline()->Distance( aRefSeg->GetPosition() ) < aRefSeg->GetWidth()/2 )
840  {
841  m_currentMarker = fillMarker( aRefSeg, NULL,
843  return false;
844  }
845  }
846  }
847 
848  return true;
849 }
KICAD_T Type() const
Function Type()
Definition: base_struct.h:198
Class ZONE_CONTAINER handles a list of polygons defining a copper zone.
Definition: class_zone.h:78
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
SHAPE_POLY_SET * Outline()
Definition: class_zone.h:247
LAYER_ID GetLayer() const
Function GetLayer returns the primary layer this item is on.
const wxPoint & GetEnd() const
Definition: class_track.h:117
#define DRCE_TRACK_INSIDE_KEEPOUT
Track in inside a keepout area.
Definition: drc_stuff.h:78
class TRACK, a track segment (segment on a copper layer)
Definition: typeinfo.h:107
BOARD * m_pcb
Definition: drc_stuff.h:205
bool GetIsKeepout() const
Accessors to parameters used in Keepout zones:
Definition: class_zone.h:644
const wxPoint & GetPosition() const override
Definition: class_track.h:111
#define DRCE_VIA_INSIDE_KEEPOUT
Via in inside a keepout area.
Definition: drc_stuff.h:77
const wxPoint & GetStart() const
Definition: class_track.h:120
int GetAreaCount() const
Function GetAreaCount.
Definition: class_board.h:1051
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
Definition: seg.h:37
bool GetDoNotAllowTracks() const
Definition: class_zone.h:647
ZONE_CONTAINER * GetArea(int index) const
Function GetArea returns the Area (Zone Container) at a given index.
Definition: class_board.h:1022
bool GetDoNotAllowVias() const
Definition: class_zone.h:646
int GetWidth() const
Definition: class_track.h:114
int Distance(VECTOR2I point)
Function DistanceToPolygon computes the minimum distance between aPoint and all the polygons in the s...
class VIA, a via (like a track segment on a copper layer)
Definition: typeinfo.h:108
int DRC::Drc ( TRACK aRefSeg,
TRACK aList 
)

Function Drc tests the current segment and returns the result and displays the error in the status panel only if one exists.

Parameters
aRefSegThe current segment to test.
aListThe track list to test (usually m_Pcb->m_Track)
Returns
int - BAD_DRC (1) if DRC error or OK_DRC (0) if OK

Definition at line 153 of file drc.cpp.

References BAD_DRC, doTrackDrc(), doTrackKeepoutDrc(), m_currentMarker, m_pcbEditorFrame, OK_DRC, EDA_DRAW_FRAME::SetMsgPanel(), and updatePointers().

Referenced by PCB_EDIT_FRAME::Add45DegreeSegment(), PCB_EDIT_FRAME::Begin_Route(), PCB_EDIT_FRAME::Begin_Zone(), PCB_EDIT_FRAME::End_Route(), PCB_EDIT_FRAME::End_Zone(), PCB_EDIT_FRAME::Other_Layer_Route(), PCB_EDIT_FRAME::PlaceDraggedOrMovedTrackSegment(), and PCB_EDIT_FRAME::SetTrackSegmentWidth().

154 {
155  updatePointers();
156 
157  if( !doTrackDrc( aRefSegm, aList, true ) )
158  {
159  wxASSERT( m_currentMarker );
160 
162  return BAD_DRC;
163  }
164 
165  if( !doTrackKeepoutDrc( aRefSegm ) )
166  {
167  wxASSERT( m_currentMarker );
168 
170  return BAD_DRC;
171  }
172 
173  return OK_DRC;
174 }
#define OK_DRC
Definition: drc_stuff.h:35
bool doTrackKeepoutDrc(TRACK *aRefSeg)
Function doTrackKeepoutDrc tests the current segment or via.
Definition: drc.cpp:805
#define BAD_DRC
Definition: drc_stuff.h:36
void SetMsgPanel(const std::vector< MSG_PANEL_ITEM > &aList)
Function SetMsgPanel clears the message panel and populates it with the contents of aList...
Definition: draw_frame.cpp:751
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
bool doTrackDrc(TRACK *aRefSeg, TRACK *aStart, bool doPads=true)
Function DoTrackDrc tests the current segment.
int DRC::Drc ( ZONE_CONTAINER aArea,
int  aCornerIndex 
)

Function Drc tests the outline segment starting at CornerIndex and returns the result and displays the error in the status panel only if one exists.

Test Edge inside other areas Test Edge too close other areas

Parameters
aAreaThe areaparent which contains the corner.
aCornerIndexThe starting point of the segment to test.
Returns
int - BAD_DRC (1) if DRC error or OK_DRC (0) if OK

Definition at line 177 of file drc.cpp.

References BAD_DRC, doEdgeZoneDrc(), m_currentMarker, m_pcbEditorFrame, OK_DRC, EDA_DRAW_FRAME::SetMsgPanel(), and updatePointers().

178 {
179  updatePointers();
180 
181  if( !doEdgeZoneDrc( aArea, aCornerIndex ) )
182  {
183  wxASSERT( m_currentMarker );
185  return BAD_DRC;
186  }
187 
188  return OK_DRC;
189 }
#define OK_DRC
Definition: drc_stuff.h:35
#define BAD_DRC
Definition: drc_stuff.h:36
void SetMsgPanel(const std::vector< MSG_PANEL_ITEM > &aList)
Function SetMsgPanel clears the message panel and populates it with the contents of aList...
Definition: draw_frame.cpp:751
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
bool doEdgeZoneDrc(ZONE_CONTAINER *aArea, int aCornerIndex)
Function doEdgeZoneDrc tests a segment in ZONE_CONTAINER * aArea: Test Edge inside other areas Test E...
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
int DRC::DrcBlind ( TRACK aRefSeg,
TRACK aList 
)
inline

Function DrcBlind tests the current segment and returns the result.

Any error is not displayed in the status panel.

Parameters
aRefSegThe current segment to test.
aListThe track list to test (usually m_Pcb->m_Track)
Returns
int - BAD_DRC (1) if DRC error or OK_DRC (0) if OK

Definition at line 451 of file drc_stuff.h.

References BAD_DRC, doTrackDrc(), doTrackKeepoutDrc(), OK_DRC, and updatePointers().

452  {
453  updatePointers();
454 
455  if( ! doTrackDrc( aRefSeg, aList ) )
456  return BAD_DRC;
457 
458  return doTrackKeepoutDrc( aRefSeg ) ? OK_DRC : BAD_DRC;
459  }
#define OK_DRC
Definition: drc_stuff.h:35
bool doTrackKeepoutDrc(TRACK *aRefSeg)
Function doTrackKeepoutDrc tests the current segment or via.
Definition: drc.cpp:805
#define BAD_DRC
Definition: drc_stuff.h:36
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
bool doTrackDrc(TRACK *aRefSeg, TRACK *aStart, bool doPads=true)
Function DoTrackDrc tests the current segment.
MARKER_PCB * DRC::fillMarker ( const TRACK aTrack,
BOARD_ITEM aItem,
int  aErrorCode,
MARKER_PCB fillMe 
)
private

Function fillMarker optionally creates a marker and fills it in with information, but does not add it to the BOARD.

Use this to report any kind of DRC problem, or unconnected pad problem.

Parameters
aTrackThe reference track.
aItemAnother item on the BOARD, such as a VIA, SEGZONE, or TRACK.
aErrorCodeA categorizing identifier for the particular type of error that is being reported.
fillMeA MARKER_PCB* which is to be filled in, or NULL if one is to first be allocated, then filled.

Definition at line 49 of file drc_marker_functions.cpp.

References TRACK::GetEnd(), GetLineLength(), TRACK::GetPosition(), TRACK::GetSelectMenuText(), EDA_ITEM::GetSelectMenuText(), TRACK::GetStart(), PCB_PAD_T, PCB_TEXT_T, PCB_TRACE_T, PCB_VIA_T, MARKER_BASE::SetData(), MARKER_PCB::SetItem(), and EDA_ITEM::Type().

Referenced by doEdgeZoneDrc(), doFootprintOverlappingDrc(), doNetClass(), doPadToPadsDrc(), doTrackDrc(), doTrackKeepoutDrc(), testKeepoutAreas(), testTexts(), and testZones().

51 {
52  wxString textA = aTrack->GetSelectMenuText();
53  wxString textB;
54 
55  wxPoint position;
56  wxPoint posB;
57 
58  if( aItem ) // aItem might be NULL
59  {
60  textB = aItem->GetSelectMenuText();
61 
62  if( aItem->Type() == PCB_PAD_T )
63  {
64  posB = position = ((D_PAD*)aItem)->GetPosition();
65  }
66  else if( aItem->Type() == PCB_VIA_T )
67  {
68  posB = position = ((VIA*)aItem)->GetPosition();
69  }
70  else if( aItem->Type() == PCB_TRACE_T )
71  {
72  TRACK* track = (TRACK*) aItem;
73 
74  posB = track->GetPosition();
75 
76  wxPoint endPos = track->GetEnd();
77 
78  // either of aItem's start or end will be used for the marker position
79  // first assume start, then switch at end if needed. decision made on
80  // distance from end of aTrack.
81  position = track->GetStart();
82 
83  double dToEnd = GetLineLength( endPos, aTrack->GetEnd() );
84  double dToStart = GetLineLength( position, aTrack->GetEnd() );
85 
86  if( dToEnd < dToStart )
87  position = endPos;
88  }
89  else if( aItem->Type() == PCB_TEXT_T )
90  {
91  position = aTrack->GetPosition();
92  posB = ((TEXTE_PCB*) aItem)->GetPosition();
93  }
94  }
95  else
96  position = aTrack->GetPosition();
97 
98  if( fillMe )
99  {
100  if( aItem )
101  fillMe->SetData( aErrorCode, position,
102  textA, aTrack->GetPosition(),
103  textB, posB );
104  else
105  fillMe->SetData( aErrorCode, position,
106  textA, aTrack->GetPosition() );
107  }
108  else
109  {
110  if( aItem )
111  {
112  fillMe = new MARKER_PCB( aErrorCode, position,
113  textA, aTrack->GetPosition(),
114  textB, posB );
115  fillMe->SetItem( aItem );
116  }
117  else
118  {
119  fillMe = new MARKER_PCB( aErrorCode, position,
120  textA, aTrack->GetPosition() );
121  }
122  }
123 
124  return fillMe;
125 }
KICAD_T Type() const
Function Type()
Definition: base_struct.h:198
double GetLineLength(const wxPoint &aPointA, const wxPoint &aPointB)
Function GetLineLength returns the length of a line segment defined by aPointA and aPointB...
Definition: trigo.h:183
class TEXTE_PCB, text on a layer
Definition: typeinfo.h:104
class D_PAD, a pad in a footprint
Definition: typeinfo.h:102
virtual wxString GetSelectMenuText() const
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
const wxPoint & GetEnd() const
Definition: class_track.h:117
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
class TRACK, a track segment (segment on a copper layer)
Definition: typeinfo.h:107
void SetItem(const BOARD_ITEM *aItem)
const wxPoint & GetPosition() const override
Definition: class_track.h:111
const wxPoint & GetStart() const
Definition: class_track.h:120
virtual wxString GetSelectMenuText() const override
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
class VIA, a via (like a track segment on a copper layer)
Definition: typeinfo.h:108
MARKER_PCB * DRC::fillMarker ( D_PAD aPad,
BOARD_ITEM aItem,
int  aErrorCode,
MARKER_PCB fillMe 
)
private

Definition at line 128 of file drc_marker_functions.cpp.

References D_PAD::GetPosition(), EDA_ITEM::GetSelectMenuText(), D_PAD::GetSelectMenuText(), PCB_PAD_T, PCB_TEXT_T, MARKER_BASE::SetData(), MARKER_PCB::SetItem(), and EDA_ITEM::Type().

129 {
130  wxString textA = aPad->GetSelectMenuText();
131  wxString textB;
132 
133  wxPoint posA = aPad->GetPosition();
134  wxPoint posB;
135 
136  if( aItem )
137  {
138  textB = aItem->GetSelectMenuText();
139 
140  switch( aItem->Type() )
141  {
142  case PCB_PAD_T:
143  posB = ((D_PAD*)aItem)->GetPosition();
144  break;
145 
146  case PCB_TEXT_T:
147  posB = ((TEXTE_PCB*)aItem)->GetPosition();
148  break;
149 
150  default:
151  wxLogDebug( wxT("fillMarker: unsupported item") );
152  break;
153  }
154  }
155 
156  if( fillMe )
157  {
158  fillMe->SetData( aErrorCode, posA, textA, posA, textB, posB );
159  }
160  else
161  {
162  fillMe = new MARKER_PCB( aErrorCode, posA, textA, posA, textB, posB );
163  fillMe->SetItem( aPad ); // TODO it has to be checked
164  }
165 
166  return fillMe;
167 }
KICAD_T Type() const
Function Type()
Definition: base_struct.h:198
wxString GetSelectMenuText() const override
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
Definition: class_pad.cpp:893
class TEXTE_PCB, text on a layer
Definition: typeinfo.h:104
class D_PAD, a pad in a footprint
Definition: typeinfo.h:102
virtual wxString GetSelectMenuText() const
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
void SetItem(const BOARD_ITEM *aItem)
const wxPoint & GetPosition() const override
Definition: class_pad.h:170
MARKER_PCB * DRC::fillMarker ( ZONE_CONTAINER aArea,
int  aErrorCode,
MARKER_PCB fillMe 
)
private

Definition at line 170 of file drc_marker_functions.cpp.

References ZONE_CONTAINER::GetPosition(), ZONE_CONTAINER::GetSelectMenuText(), MARKER_BASE::SetData(), and MARKER_PCB::SetItem().

171 {
172  wxString textA = aArea->GetSelectMenuText();
173 
174  wxPoint posA = aArea->GetPosition();
175 
176  if( fillMe )
177  {
178  fillMe->SetData( aErrorCode, posA, textA, posA );
179  }
180  else
181  {
182  fillMe = new MARKER_PCB( aErrorCode, posA, textA, posA );
183  fillMe->SetItem( aArea );
184  }
185 
186  return fillMe;
187 }
wxString GetSelectMenuText() const override
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
Definition: class_zone.cpp:825
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
void SetItem(const BOARD_ITEM *aItem)
const wxPoint & GetPosition() const override
Function GetPosition.
Definition: class_zone.cpp:167
MARKER_PCB * DRC::fillMarker ( const wxPoint aPos,
int  aErrorCode,
const wxString &  aMessage,
MARKER_PCB fillMe 
)
private

Definition at line 228 of file drc_marker_functions.cpp.

References MARKER_BASE::SetData().

229 {
230  wxPoint posA = aPos;
231 
232  if( fillMe )
233  fillMe->SetData( aErrorCode, posA, aMessage, posA );
234  else
235  fillMe = new MARKER_PCB( aErrorCode, posA, aMessage, posA );
236 
237  return fillMe;
238 }
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
MARKER_PCB * DRC::fillMarker ( const ZONE_CONTAINER aArea,
const wxPoint aPos,
int  aErrorCode,
MARKER_PCB fillMe 
)
private

Function fillMarker optionally creates a marker and fills it in with information, but does not add it to the BOARD.

Use this to report any kind of DRC problem, or unconnected pad problem.

Parameters
aAreaThe zone to test
aPosposition of error
aErrorCodeType of error
fillMeA MARKER_PCB* which is to be filled in, or NULL if one is to first be allocated, then filled.

Definition at line 190 of file drc_marker_functions.cpp.

References ZONE_CONTAINER::GetSelectMenuText(), MARKER_BASE::SetData(), and MARKER_PCB::SetItem().

194 {
195  wxString textA = aArea->GetSelectMenuText();
196 
197  wxPoint posA = aPos;
198 
199  if( fillMe )
200  {
201  fillMe->SetData( aErrorCode, posA, textA, posA );
202  }
203  else
204  {
205  fillMe = new MARKER_PCB( aErrorCode, posA, textA, posA );
206  fillMe->SetItem( aArea );
207  }
208 
209  return fillMe;
210 }
wxString GetSelectMenuText() const override
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
Definition: class_zone.cpp:825
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
void SetItem(const BOARD_ITEM *aItem)
MARKER_PCB * DRC::fillMarker ( int  aErrorCode,
const wxString &  aMessage,
MARKER_PCB fillMe 
)
private

Function fillMarker fills a MARKER which will report on a generic problem with the board which is not geographically locatable.

Definition at line 213 of file drc_marker_functions.cpp.

References MARKER_BASE::SetData(), and MARKER_BASE::SetShowNoCoordinate().

214 {
215  wxPoint posA; // not displayed
216 
217  if( fillMe )
218  fillMe->SetData( aErrorCode, posA, aMessage, posA );
219  else
220  fillMe = new MARKER_PCB( aErrorCode, posA, aMessage, posA );
221 
222  fillMe->SetShowNoCoordinate();
223 
224  return fillMe;
225 }
void SetShowNoCoordinate()
void SetData(int aErrorCode, const wxPoint &aMarkerPos, const wxString &aText, const wxPoint &aPos, const wxString &bText, const wxPoint &bPos)
Function SetData fills in all the reportable data associated with a MARKER.
MARKER_PCB* DRC::GetCurrentMarker ( )
inline
Returns
a pointer to the current marker (last created marker

Definition at line 534 of file drc_stuff.h.

References m_currentMarker.

Referenced by PCB_EDIT_FRAME::Other_Layer_Route().

535  {
536  return m_currentMarker;
537  }
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
void DRC::ListUnconnectedPads ( )

Function ListUnconnectedPad gathers a list of all the unconnected pads and shows them in the dialog, and optionally prints a report of such.

Definition at line 326 of file drc.cpp.

References testUnconnected(), and updatePointers().

Referenced by DIALOG_DRC_CONTROL::OnListUnconnectedClick().

327 {
328  testUnconnected();
329 
330  // update the m_drcDialog listboxes
331  updatePointers();
332 }
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
void testUnconnected()
Definition: drc.cpp:559
void DRC::RunTests ( wxTextCtrl *  aMessages = NULL)

Function RunTests will actually run all the tests specified with a previous call to SetSettings()

Parameters
aMessages= a wxTextControl where to display some activity messages. Can be NULL

Definition at line 192 of file drc.cpp.

References PCB_BASE_FRAME::Compile_Ratsnest(), doFootprintOverlappingDrc(), PCB_EDIT_FRAME::Fill_All_Zones(), PCB_BASE_FRAME::GetBoard(), BOARD::GetRatsnest(), LISTE_RATSNEST_ITEM_OK, m_doFootprintOverlapping, m_doKeepoutTest, m_doNoCourtyardDefined, m_doPad2PadTest, m_doUnconnectedTest, m_pcb, m_pcbEditorFrame, BOARD::m_Status_Pcb, RN_DATA::ProcessBoard(), testKeepoutAreas(), testNetClasses(), testPad2Pad(), testTexts(), testTracks(), testUnconnected(), testZones(), and updatePointers().

Referenced by DIALOG_DRC_CONTROL::OnStartdrcClick().

193 {
194  // be sure m_pcb is the current board, not a old one
195  // ( the board can be reloaded )
197 
198  // Ensure ratsnest is up to date:
200  {
201  if( aMessages )
202  {
203  aMessages->AppendText( _( "Compile ratsnest...\n" ) );
204  wxSafeYield();
205  }
206 
207  m_pcbEditorFrame->Compile_Ratsnest( NULL, true );
209  }
210 
211  // someone should have cleared the two lists before calling this.
212 
213  if( !testNetClasses() )
214  {
215  // testing the netclasses is a special case because if the netclasses
216  // do not pass the BOARD_DESIGN_SETTINGS checks, then every member of a net
217  // class (a NET) will cause its items such as tracks, vias, and pads
218  // to also fail. So quit after *all* netclass errors have been reported.
219  if( aMessages )
220  aMessages->AppendText( _( "Aborting\n" ) );
221 
222  // update the m_drcDialog listboxes
223  updatePointers();
224 
225  return;
226  }
227 
228  // test pad to pad clearances, nothing to do with tracks, vias or zones.
229  if( m_doPad2PadTest )
230  {
231  if( aMessages )
232  {
233  aMessages->AppendText( _( "Pad clearances...\n" ) );
234  wxSafeYield();
235  }
236 
237  testPad2Pad();
238  }
239 
240  // test track and via clearances to other tracks, pads, and vias
241  if( aMessages )
242  {
243  aMessages->AppendText( _( "Track clearances...\n" ) );
244  wxSafeYield();
245  }
246 
247  testTracks( aMessages ? aMessages->GetParent() : m_pcbEditorFrame, true );
248 
249  // Before testing segments and unconnected, refill all zones:
250  // this is a good caution, because filled areas can be outdated.
251  if( aMessages )
252  {
253  aMessages->AppendText( _( "Fill zones...\n" ) );
254  wxSafeYield();
255  }
256 
257  m_pcbEditorFrame->Fill_All_Zones( aMessages ? aMessages->GetParent() : m_pcbEditorFrame,
258  false );
259 
260  // test zone clearances to other zones
261  if( aMessages )
262  {
263  aMessages->AppendText( _( "Test zones...\n" ) );
264  wxSafeYield();
265  }
266 
267  testZones();
268 
269  // find and gather unconnected pads.
270  if( m_doUnconnectedTest )
271  {
272  if( aMessages )
273  {
274  aMessages->AppendText( _( "Unconnected pads...\n" ) );
275  aMessages->Refresh();
276  }
277 
278  testUnconnected();
279  }
280 
281  // find and gather vias, tracks, pads inside keepout areas.
282  if( m_doKeepoutTest )
283  {
284  if( aMessages )
285  {
286  aMessages->AppendText( _( "Keepout areas ...\n" ) );
287  aMessages->Refresh();
288  }
289 
291  }
292 
293  // find and gather vias, tracks, pads inside text boxes.
294  if( aMessages )
295  {
296  aMessages->AppendText( _( "Test texts...\n" ) );
297  wxSafeYield();
298  }
299 
300  testTexts();
301 
302  // find overlaping courtyard ares.
304  {
305  if( aMessages )
306  {
307  aMessages->AppendText( _( "Courtyard areas...\n" ) );
308  aMessages->Refresh();
309  }
310 
312  }
313 
314  // update the m_drcDialog listboxes
315  updatePointers();
316 
317  if( aMessages )
318  {
319  // no newline on this one because it is last, don't want the window
320  // to unnecessarily scroll.
321  aMessages->AppendText( _( "Finished" ) );
322  }
323 }
bool m_doNoCourtyardDefined
Definition: drc_stuff.h:172
int Fill_All_Zones(wxWindow *aActiveWindow, bool aVerbose=true)
Function Fill_All_Zones Fill all zones on the board The old fillings are removed. ...
void testKeepoutAreas()
Definition: drc.cpp:632
BOARD * GetBoard() const
void testTexts()
Definition: drc.cpp:681
BOARD * m_pcb
Definition: drc_stuff.h:205
bool m_doFootprintOverlapping
Definition: drc_stuff.h:171
bool m_doKeepoutTest
Definition: drc_stuff.h:169
void testZones()
Definition: drc.cpp:594
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
void ProcessBoard()
Function ProcessBoard() Prepares data for computing (computes a list of current nodes and connections...
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
bool m_doPad2PadTest
Definition: drc_stuff.h:166
void testPad2Pad()
Definition: drc.cpp:465
RN_DATA * GetRatsnest() const
Function GetRatsnest() returns list of missing connections between components/tracks.
Definition: class_board.h:287
void Compile_Ratsnest(wxDC *aDC, bool aDisplayStatus)
Function Compile_Ratsnest Create the entire board ratsnest.
Definition: ratsnest.cpp:165
bool doFootprintOverlappingDrc()
Function doFootprintOverlappingDrc tests for footprint courtyard overlaps.
Definition: drc.cpp:986
bool testNetClasses()
Function testNetClasses goes through each NETCLASS and verifies that its clearance, via size, track width, and track clearance are larger than those in board.m_designSettings.
Definition: drc.cpp:442
void testTracks(wxWindow *aActiveWindow, bool aShowProgressBar)
Function testTracks performs the DRC on all tracks.
Definition: drc.cpp:504
void testUnconnected()
Definition: drc.cpp:559
bool m_doUnconnectedTest
Definition: drc_stuff.h:167
int m_Status_Pcb
Flags used in ratsnest calculation and update.
Definition: class_board.h:240
void DRC::SetSettings ( bool  aPad2PadTest,
bool  aUnconnectedTest,
bool  aZonesTest,
bool  aKeepoutTest,
bool  aCourtyardTest,
bool  aCourtyardMissingTest,
const wxString &  aReportName,
bool  aSaveReport 
)
inline

Function SetSettings saves all the UI or test settings and may be called before running the tests.

Parameters
aPad2PadTestTells whether to test pad to pad distances.
aUnconnectedTestTells whether to list unconnected pads.
aZonesTestTells whether to test zones.
aKeepoutTestTells whether to test keepout areas.
aCourtyardTestTells whether to test footprint courtyard overlap.
aCourtyardMissingTestTells whether to test missing courtyard definition in footprint.
aReportNameA string telling the disk file report name entered.
aSaveReportA boolean telling whether to generate disk file report.

Definition at line 500 of file drc_stuff.h.

Referenced by DIALOG_DRC_CONTROL::OnListUnconnectedClick(), and DIALOG_DRC_CONTROL::OnStartdrcClick().

504  {
505  m_doPad2PadTest = aPad2PadTest;
506  m_doUnconnectedTest = aUnconnectedTest;
507  m_doZonesTest = aZonesTest;
508  m_doKeepoutTest = aKeepoutTest;
509  m_rptFilename = aReportName;
510  m_doCreateRptFile = aSaveReport;
511  m_doFootprintOverlapping = aCourtyardTest;
512  m_doNoCourtyardDefined = aCourtyardMissingTest;
513  }
bool m_doNoCourtyardDefined
Definition: drc_stuff.h:172
bool m_doCreateRptFile
Definition: drc_stuff.h:170
bool m_doFootprintOverlapping
Definition: drc_stuff.h:171
bool m_doKeepoutTest
Definition: drc_stuff.h:169
bool m_doZonesTest
Definition: drc_stuff.h:168
bool m_doPad2PadTest
Definition: drc_stuff.h:166
wxString m_rptFilename
Definition: drc_stuff.h:174
bool m_doUnconnectedTest
Definition: drc_stuff.h:167
void DRC::ShowDRCDialog ( wxWindow *  aParent = NULL)

Function ShowDRCDialog opens a dialog and prompts the user, then if a test run button is clicked, runs the test(s) and creates the MARKERS.

The dialog is only created if it is not already in existence.

Parameters
aParentis the parent window for wxWidgets. Usually the PCB editor frame but can be an other dialog if aParent == NULL (default), the parent will be the PCB editor frame and the dialog will be not modal (just float on parent if aParent is specified, the dialog will be modal. The modal mode is mandatory if the dialog is created from an other dialog, not from the PCB editor frame

Definition at line 56 of file drc.cpp.

References DIALOG_DRC_CONTROL, EDA_DRAW_FRAME::GetToolManager(), m_doCreateRptFile, m_drcDialog, m_pcbEditorFrame, m_rptFilename, TOOL_MANAGER::RunAction(), PCB_ACTIONS::selectionClear, DIALOG_DRC_CONTROL::SetRptSettings(), DIALOG_SHIM::Show(), and updatePointers().

Referenced by DIALOG_PLOT::onRunDRC(), and PCB_EDIT_FRAME::Process_Special_Functions().

57 {
58  bool show_dlg_modal = true;
59 
60  // the dialog needs a parent frame. if it is not specified, this is
61  // the PCB editor frame specified in DRC class.
62  if( aParent == NULL )
63  {
64  // if any parent is specified, the dialog is modal.
65  // if this is the default PCB editor frame, it is not modal
66  show_dlg_modal = false;
67  aParent = m_pcbEditorFrame;
68  }
69 
70  if( !m_drcDialog )
71  {
73  m_drcDialog = new DIALOG_DRC_CONTROL( this, m_pcbEditorFrame, aParent );
75 
77 
78  if( show_dlg_modal )
79  m_drcDialog->ShowModal();
80  else
81  m_drcDialog->Show( true );
82  }
83  else // The dialog is just not visible (because the user has double clicked on an error item)
84  {
86  m_drcDialog->Show( true );
87  }
88 }
static TOOL_ACTION selectionClear
Clears the current selection.
Definition: pcb_actions.h:53
bool m_doCreateRptFile
Definition: drc_stuff.h:170
DIALOG_DRC_CONTROL * m_drcDialog
Definition: drc_stuff.h:206
bool RunAction(const std::string &aActionName, bool aNow=false, T aParam=NULL)
Function RunAction() Runs the specified action.
Definition: tool_manager.h:125
void updatePointers()
Function updatePointers is a private helper function used to update needed pointers from the one poin...
Definition: drc.cpp:335
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
bool Show(bool show) override
friend class DIALOG_DRC_CONTROL
Definition: drc_stuff.h:160
TOOL_MANAGER * GetToolManager() const
Function GetToolManager returns the tool manager instance, if any.
Definition: draw_frame.h:810
wxString m_rptFilename
Definition: drc_stuff.h:174
void SetRptSettings(bool aEnable, const wxString &aFileName)
Enable/disable the report file creation.
Definition: dialog_drc.cpp:156
void DRC::testKeepoutAreas ( )
private

Definition at line 632 of file drc.cpp.

References addMarkerToPcb(), SHAPE_POLY_SET::Distance(), DRCE_TRACK_INSIDE_KEEPOUT, DRCE_VIA_INSIDE_KEEPOUT, fillMarker(), BOARD::GetArea(), BOARD::GetAreaCount(), ZONE_CONTAINER::GetDoNotAllowTracks(), ZONE_CONTAINER::GetDoNotAllowVias(), ZONE_CONTAINER::GetIsKeepout(), BOARD_ITEM::GetLayer(), m_currentMarker, m_pcb, BOARD::m_Track, TRACK::Next(), ZONE_CONTAINER::Outline(), PCB_TRACE_T, and PCB_VIA_T.

Referenced by RunTests().

633 {
634  // Test keepout areas for vias, tracks and pads inside keepout areas
635  for( int ii = 0; ii < m_pcb->GetAreaCount(); ii++ )
636  {
637  ZONE_CONTAINER* area = m_pcb->GetArea( ii );
638 
639  if( !area->GetIsKeepout() )
640  continue;
641 
642  for( TRACK* segm = m_pcb->m_Track; segm != NULL; segm = segm->Next() )
643  {
644  if( segm->Type() == PCB_TRACE_T )
645  {
646  if( ! area->GetDoNotAllowTracks() )
647  continue;
648 
649  if( segm->GetLayer() != area->GetLayer() )
650  continue;
651 
652  if( area->Outline()->Distance( SEG( segm->GetStart(), segm->GetEnd() ),
653  segm->GetWidth() ) == 0 )
654  {
655  addMarkerToPcb( fillMarker( segm, NULL,
657  m_currentMarker = nullptr;
658  }
659  }
660  else if( segm->Type() == PCB_VIA_T )
661  {
662  if( ! area->GetDoNotAllowVias() )
663  continue;
664 
665  if( ! ((VIA*)segm)->IsOnLayer( area->GetLayer() ) )
666  continue;
667 
668  if( area->Outline()->Distance( segm->GetPosition() ) < segm->GetWidth()/2 )
669  {
670  addMarkerToPcb( fillMarker( segm, NULL,
672  m_currentMarker = nullptr;
673  }
674  }
675  }
676  // Test pads: TODO
677  }
678 }
Class ZONE_CONTAINER handles a list of polygons defining a copper zone.
Definition: class_zone.h:78
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
SHAPE_POLY_SET * Outline()
Definition: class_zone.h:247
LAYER_ID GetLayer() const
Function GetLayer returns the primary layer this item is on.
#define DRCE_TRACK_INSIDE_KEEPOUT
Track in inside a keepout area.
Definition: drc_stuff.h:78
class TRACK, a track segment (segment on a copper layer)
Definition: typeinfo.h:107
BOARD * m_pcb
Definition: drc_stuff.h:205
bool GetIsKeepout() const
Accessors to parameters used in Keepout zones:
Definition: class_zone.h:644
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
#define DRCE_VIA_INSIDE_KEEPOUT
Via in inside a keepout area.
Definition: drc_stuff.h:77
int GetAreaCount() const
Function GetAreaCount.
Definition: class_board.h:1051
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
Definition: seg.h:37
bool GetDoNotAllowTracks() const
Definition: class_zone.h:647
TRACK * Next() const
Definition: class_track.h:97
ZONE_CONTAINER * GetArea(int index) const
Function GetArea returns the Area (Zone Container) at a given index.
Definition: class_board.h:1022
bool GetDoNotAllowVias() const
Definition: class_zone.h:646
int Distance(VECTOR2I point)
Function DistanceToPolygon computes the minimum distance between aPoint and all the polygons in the s...
class VIA, a via (like a track segment on a copper layer)
Definition: typeinfo.h:108
DLIST< TRACK > m_Track
Definition: class_board.h:244
bool DRC::testNetClasses ( )
private

Function testNetClasses goes through each NETCLASS and verifies that its clearance, via size, track width, and track clearance are larger than those in board.m_designSettings.

This is necessary because the actual DRC checks are run against the NETCLASS limits, so in order enforce global limits, we first check the NETCLASSes against the global limits.

Returns
bool - true if succes, else false but only after reporting all NETCLASS violations.

Definition at line 442 of file drc.cpp.

References NETCLASSES::begin(), doNetClass(), NETCLASSES::end(), NETCLASSES::GetDefault(), BOARD::GetDesignSettings(), BOARD_DESIGN_SETTINGS::m_NetClasses, and m_pcb.

Referenced by RunTests().

443 {
444  bool ret = true;
445 
447 
448  wxString msg; // construct this only once here, not in a loop, since somewhat expensive.
449 
450  if( !doNetClass( netclasses.GetDefault(), msg ) )
451  ret = false;
452 
453  for( NETCLASSES::const_iterator i = netclasses.begin(); i != netclasses.end(); ++i )
454  {
455  NETCLASSPTR nc = i->second;
456 
457  if( !doNetClass( nc, msg ) )
458  ret = false;
459  }
460 
461  return ret;
462 }
iterator end()
NETCLASS_MAP::const_iterator const_iterator
BOARD * m_pcb
Definition: drc_stuff.h:205
iterator begin()
Class NETCLASSES is a container for NETCLASS instances.
BOARD_DESIGN_SETTINGS & GetDesignSettings() const
Function GetDesignSettings.
Definition: class_board.h:530
NETCLASSPTR GetDefault() const
Function GetDefault.
bool doNetClass(std::shared_ptr< NETCLASS > aNetClass, wxString &msg)
Definition: drc.cpp:350
NETCLASSES m_NetClasses
List of current netclasses. There is always the default netclass.
void DRC::testPad2Pad ( )
private

Definition at line 465 of file drc.cpp.

References addMarkerToPcb(), doPadToPadsDrc(), D_PAD::GetBoundingRadius(), D_PAD::GetClearance(), D_PAD::GetPosition(), BOARD::GetSortedPadListByXthenYCoord(), m_currentMarker, m_pcb, and wxPoint::x.

Referenced by RunTests().

466 {
467  std::vector<D_PAD*> sortedPads;
468 
469  m_pcb->GetSortedPadListByXthenYCoord( sortedPads );
470 
471  // find the max size of the pads (used to stop the test)
472  int max_size = 0;
473 
474  for( unsigned i = 0; i < sortedPads.size(); ++i )
475  {
476  D_PAD* pad = sortedPads[i];
477 
478  // GetBoundingRadius() is the radius of the minimum sized circle fully containing the pad
479  int radius = pad->GetBoundingRadius();
480  if( radius > max_size )
481  max_size = radius;
482  }
483 
484  // Test the pads
485  D_PAD** listEnd = &sortedPads[ sortedPads.size() ];
486 
487  for( unsigned i = 0; i< sortedPads.size(); ++i )
488  {
489  D_PAD* pad = sortedPads[i];
490 
491  int x_limit = max_size + pad->GetClearance() +
492  pad->GetBoundingRadius() + pad->GetPosition().x;
493 
494  if( !doPadToPadsDrc( pad, &sortedPads[i], listEnd, x_limit ) )
495  {
496  wxASSERT( m_currentMarker );
498  m_currentMarker = nullptr;
499  }
500  }
501 }
void GetSortedPadListByXthenYCoord(std::vector< D_PAD * > &aVector, int aNetCode=-1)
Function GetSortedPadListByXthenYCoord first empties then fills the vector with all pads and sorts th...
BOARD * m_pcb
Definition: drc_stuff.h:205
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
int GetBoundingRadius() const
Function GetBoundingRadius returns the radius of a minimum sized circle which fully encloses this pad...
Definition: class_pad.h:428
const wxPoint & GetPosition() const override
Definition: class_pad.h:170
bool doPadToPadsDrc(D_PAD *aRefPad, D_PAD **aStart, D_PAD **aEnd, int x_limit)
Function doPadToPadsDrc tests the clearance between aRefPad and other pads.
Definition: drc.cpp:852
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
int GetClearance(BOARD_CONNECTED_ITEM *aItem=NULL) const override
Function GetClearance returns the clearance in internal units.
Definition: class_pad.cpp:455
void DRC::testTexts ( )
private

Definition at line 681 of file drc.cpp.

References addMarkerToPcb(), ArcTangente(), checkClearanceSegmToPad(), delta, dist, DRCE_PAD_INSIDE_TEXT, DRCE_TRACK_INSIDE_TEXT, DRCE_VIA_INSIDE_TEXT, fillMarker(), D_PAD::GetClearance(), BOARD::GetPads(), EDA_TEXT::GetThickness(), IsCopperLayer(), D_PAD::IsOnLayer(), m_currentMarker, BOARD::m_Drawings, m_padToTestPos, m_pcb, m_segmAngle, m_segmEnd, m_segmLength, BOARD::m_Track, TRACK::Next(), BOARD_ITEM::Next(), PCB_TEXT_T, PCB_TRACE_T, PCB_VIA_T, SEG::PointCloserThan(), RotatePoint(), D_PAD::ShapePos(), EDA_TEXT::TransformTextShapeToSegmentList(), wxPoint::x, and wxPoint::y.

Referenced by RunTests().

682 {
683  std::vector<wxPoint> textShape; // a buffer to store the text shape (set of segments)
684  std::vector<D_PAD*> padList = m_pcb->GetPads();
685 
686  // Test text areas for vias, tracks and pads inside text areas
687  for( BOARD_ITEM* item = m_pcb->m_Drawings; item; item = item->Next() )
688  {
689  // Drc test only items on copper layers
690  if( ! IsCopperLayer( item->GetLayer() ) )
691  continue;
692 
693  // only texts on copper layers are tested
694  if( item->Type() != PCB_TEXT_T )
695  continue;
696 
697  textShape.clear();
698 
699  // So far the bounding box makes up the text-area
700  TEXTE_PCB* text = (TEXTE_PCB*) item;
701  text->TransformTextShapeToSegmentList( textShape );
702 
703  if( textShape.size() == 0 ) // Should not happen (empty text?)
704  continue;
705 
706  for( TRACK* track = m_pcb->m_Track; track != NULL; track = track->Next() )
707  {
708  if( ! track->IsOnLayer( item->GetLayer() ) )
709  continue;
710 
711  // Test the distance between each segment and the current track/via
712  int min_dist = ( track->GetWidth() + text->GetThickness() ) /2 +
713  track->GetClearance(NULL);
714 
715  if( track->Type() == PCB_TRACE_T )
716  {
717  SEG segref( track->GetStart(), track->GetEnd() );
718 
719  // Error condition: Distance between text segment and track segment is
720  // smaller than the clearance of the segment
721  for( unsigned jj = 0; jj < textShape.size(); jj += 2 )
722  {
723  SEG segtest( textShape[jj], textShape[jj+1] );
724  int dist = segref.Distance( segtest );
725 
726  if( dist < min_dist )
727  {
728  addMarkerToPcb( fillMarker( track, text,
730  m_currentMarker ) );
731  m_currentMarker = nullptr;
732  break;
733  }
734  }
735  }
736  else if( track->Type() == PCB_VIA_T )
737  {
738  // Error condition: Distance between text segment and via is
739  // smaller than the clearance of the via
740  for( unsigned jj = 0; jj < textShape.size(); jj += 2 )
741  {
742  SEG segtest( textShape[jj], textShape[jj+1] );
743 
744  if( segtest.PointCloserThan( track->GetPosition(), min_dist ) )
745  {
746  addMarkerToPcb( fillMarker( track, text,
748  m_currentMarker = nullptr;
749  break;
750  }
751  }
752  }
753  }
754 
755  // Test pads
756  for( unsigned ii = 0; ii < padList.size(); ii++ )
757  {
758  D_PAD* pad = padList[ii];
759 
760  if( ! pad->IsOnLayer( item->GetLayer() ) )
761  continue;
762 
763  wxPoint shape_pos = pad->ShapePos();
764 
765  for( unsigned jj = 0; jj < textShape.size(); jj += 2 )
766  {
767  /* In order to make some calculations more easier or faster,
768  * pads and tracks coordinates will be made relative
769  * to the segment origin
770  */
771  wxPoint origin = textShape[jj]; // origin will be the origin of other coordinates
772  m_segmEnd = textShape[jj+1] - origin;
774  m_segmAngle = 0;
775 
776  // for a non horizontal or vertical segment Compute the segment angle
777  // in tenths of degrees and its length
778  if( delta.x || delta.y ) // delta.x == delta.y == 0 for vias
779  {
780  // Compute the segment angle in 0,1 degrees
781  m_segmAngle = ArcTangente( delta.y, delta.x );
782 
783  // Compute the segment length: we build an equivalent rotated segment,
784  // this segment is horizontal, therefore dx = length
785  RotatePoint( &delta, m_segmAngle ); // delta.x = length, delta.y = 0
786  }
787 
788  m_segmLength = delta.x;
789  m_padToTestPos = shape_pos - origin;
790 
791  if( !checkClearanceSegmToPad( pad, text->GetThickness(),
792  pad->GetClearance(NULL) ) )
793  {
794  addMarkerToPcb( fillMarker( pad, text,
796  m_currentMarker = nullptr;
797  break;
798  }
799  }
800  }
801  }
802 }
const D_PADS & GetPads()
Function GetPads returns a reference to a list of all the pads.
Definition: class_board.h:762
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
Class BOARD_ITEM is a base class for any item which can be embedded within the BOARD container class...
static const int dist[10][10]
Definition: dist.cpp:57
class TEXTE_PCB, text on a layer
Definition: typeinfo.h:104
int m_segmLength
Definition: drc_stuff.h:194
#define DRCE_VIA_INSIDE_TEXT
Via in inside a text area.
Definition: drc_stuff.h:80
void RotatePoint(int *pX, int *pY, double angle)
Definition: trigo.cpp:317
#define DRCE_PAD_INSIDE_TEXT
Pad in inside a text area.
Definition: drc_stuff.h:82
wxPoint m_padToTestPos
Definition: drc_stuff.h:185
static const int delta[8][2]
Definition: solve.cpp:112
class TRACK, a track segment (segment on a copper layer)
Definition: typeinfo.h:107
int GetThickness() const
Function GetThickness returns pen width.
Definition: eda_text.h:154
bool IsOnLayer(LAYER_ID aLayer) const override
Function IsOnLayer tests to see if this object is on the given layer.
Definition: class_pad.h:479
BOARD * m_pcb
Definition: drc_stuff.h:205
BOARD_ITEM * Next() const
#define DRCE_TRACK_INSIDE_TEXT
Track in inside a text area.
Definition: drc_stuff.h:81
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
double ArcTangente(int dy, int dx)
Definition: trigo.cpp:271
DLIST< BOARD_ITEM > m_Drawings
Definition: class_board.h:242
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
Definition: seg.h:37
bool checkClearanceSegmToPad(const D_PAD *aPad, int aSegmentWidth, int aMinDist)
Function checkClearanceSegmToPad check the distance from a pad to segment.
wxPoint m_segmEnd
Definition: drc_stuff.h:186
TRACK * Next() const
Definition: class_track.h:97
void TransformTextShapeToSegmentList(std::vector< wxPoint > &aCornerBuffer) const
Convert the text shape to a list of segment each segment is stored as 2 wxPoints: the starting point ...
Definition: eda_text.cpp:507
int GetClearance(BOARD_CONNECTED_ITEM *aItem=NULL) const override
Function GetClearance returns the clearance in internal units.
Definition: class_pad.cpp:455
wxPoint ShapePos() const
Definition: class_pad.cpp:367
bool IsCopperLayer(LAYER_NUM aLayerId)
Function IsCopperLayer tests whether a layer is a copper layer.
class VIA, a via (like a track segment on a copper layer)
Definition: typeinfo.h:108
DLIST< TRACK > m_Track
Definition: class_board.h:244
double m_segmAngle
Definition: drc_stuff.h:193
void DRC::testTracks ( wxWindow *  aActiveWindow,
bool  aShowProgressBar 
)
private

Function testTracks performs the DRC on all tracks.

because this test can take a while, a progress bar can be displayed

Parameters
aActiveWindow= the active window ued as parent for the progress bar
aShowProgressBar= true to show a progress bar (Note: it is shown only if there are many tracks)

Definition at line 504 of file drc.cpp.

References addMarkerToPcb(), delta, doTrackDrc(), m_currentMarker, m_pcb, BOARD::m_Track, and TRACK::Next().

Referenced by RunTests().

505 {
506  wxProgressDialog * progressDialog = NULL;
507  const int delta = 500; // This is the number of tests between 2 calls to the
508  // progress bar
509  int count = 0;
510  for( TRACK* segm = m_pcb->m_Track; segm && segm->Next(); segm = segm->Next() )
511  count++;
512 
513  int deltamax = count/delta;
514 
515  if( aShowProgressBar && deltamax > 3 )
516  {
517  progressDialog = new wxProgressDialog( _( "Track clearances" ), wxEmptyString,
518  deltamax, aActiveWindow,
519  wxPD_AUTO_HIDE | wxPD_CAN_ABORT |
520  wxPD_APP_MODAL | wxPD_ELAPSED_TIME );
521  progressDialog->Update( 0, wxEmptyString );
522  }
523 
524  int ii = 0;
525  count = 0;
526 
527  for( TRACK* segm = m_pcb->m_Track; segm; segm = segm->Next() )
528  {
529  if ( ii++ > delta )
530  {
531  ii = 0;
532  count++;
533 
534  if( progressDialog )
535  {
536  if( !progressDialog->Update( count, wxEmptyString ) )
537  break; // Aborted by user
538 #ifdef __WXMAC__
539  // Work around a dialog z-order issue on OS X
540  if( count == deltamax )
541  aActiveWindow->Raise();
542 #endif
543  }
544  }
545 
546  if( !doTrackDrc( segm, segm->Next(), true ) )
547  {
548  wxASSERT( m_currentMarker );
550  m_currentMarker = nullptr;
551  }
552  }
553 
554  if( progressDialog )
555  progressDialog->Destroy();
556 }
static const int delta[8][2]
Definition: solve.cpp:112
BOARD * m_pcb
Definition: drc_stuff.h:205
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
TRACK * Next() const
Definition: class_track.h:97
bool doTrackDrc(TRACK *aRefSeg, TRACK *aStart, bool doPads=true)
Function DoTrackDrc tests the current segment.
DLIST< TRACK > m_Track
Definition: class_board.h:244
void DRC::testUnconnected ( )
private

Definition at line 559 of file drc.cpp.

References CH_ACTIF, PCB_BASE_FRAME::Compile_Ratsnest(), DRCE_UNCONNECTED_PADS, EDA_DRAW_FRAME::GetCanvas(), BOARD_CONNECTED_ITEM::GetNetname(), D_PAD::GetPosition(), BOARD::GetRatsnestsCount(), D_PAD::GetSelectMenuText(), LISTE_RATSNEST_ITEM_OK, BOARD::m_FullRatsnest, RATSNEST_ITEM::m_PadEnd, RATSNEST_ITEM::m_PadStart, m_pcb, m_pcbEditorFrame, RATSNEST_ITEM::m_Status, BOARD::m_Status_Pcb, and m_unconnected.

Referenced by ListUnconnectedPads(), and RunTests().

560 {
562  {
563  wxClientDC dc( m_pcbEditorFrame->GetCanvas() );
564  m_pcbEditorFrame->Compile_Ratsnest( &dc, true );
565  }
566 
567  if( m_pcb->GetRatsnestsCount() == 0 )
568  return;
569 
570  wxString msg;
571 
572  for( unsigned ii = 0; ii < m_pcb->GetRatsnestsCount(); ++ii )
573  {
574  RATSNEST_ITEM& rat = m_pcb->m_FullRatsnest[ii];
575 
576  if( (rat.m_Status & CH_ACTIF) == 0 )
577  continue;
578 
579  D_PAD* padStart = rat.m_PadStart;
580  D_PAD* padEnd = rat.m_PadEnd;
581 
582  msg = padStart->GetSelectMenuText() + wxT( " net " ) + padStart->GetNetname();
583 
584  DRC_ITEM* uncItem = new DRC_ITEM( DRCE_UNCONNECTED_PADS,
585  msg,
586  padEnd->GetSelectMenuText(),
587  padStart->GetPosition(), padEnd->GetPosition() );
588 
589  m_unconnected.push_back( uncItem );
590  }
591 }
wxString GetSelectMenuText() const override
Function GetSelectMenuText returns the text to display to be used in the selection clarification cont...
Definition: class_pad.cpp:893
Class DRC_ITEM is a holder for a DRC (in Pcbnew) or ERC (in Eeschema) error item. ...
EDA_DRAW_PANEL * GetCanvas()
Definition: draw_frame.h:299
BOARD * m_pcb
Definition: drc_stuff.h:205
#define CH_ACTIF
Definition: class_netinfo.h:60
std::vector< RATSNEST_ITEM > m_FullRatsnest
Ratsnest list for the BOARD.
Definition: class_board.h:248
D_PAD * m_PadEnd
Definition: class_netinfo.h:76
unsigned GetRatsnestsCount() const
Function GetNumRatsnests.
Definition: class_board.h:704
const wxPoint & GetPosition() const override
Definition: class_pad.h:170
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
void Compile_Ratsnest(wxDC *aDC, bool aDisplayStatus)
Function Compile_Ratsnest Create the entire board ratsnest.
Definition: ratsnest.cpp:165
D_PAD * m_PadStart
Definition: class_netinfo.h:75
#define DRCE_UNCONNECTED_PADS
pads are unconnected
Definition: drc_stuff.h:41
const wxString & GetNetname() const
Function GetNetname.
Class RATSNEST_ITEM describes a ratsnest line: a straight line connecting 2 pads. ...
Definition: class_netinfo.h:68
DRC_LIST m_unconnected
list of unconnected pads, as DRC_ITEMs
Definition: drc_stuff.h:208
int m_Status_Pcb
Flags used in ratsnest calculation and update.
Definition: class_board.h:240
void DRC::testZones ( )
private

Definition at line 594 of file drc.cpp.

References addMarkerToPcb(), DRCE_SUSPICIOUS_NET_FOR_ZONE_OUTLINE, fillMarker(), BOARD::GetArea(), BOARD::GetAreaCount(), BOARD_CONNECTED_ITEM::GetNet(), BOARD_CONNECTED_ITEM::GetNetCode(), NETINFO_ITEM::GetNodesCount(), ZONE_CONTAINER::IsOnCopperLayer(), m_currentMarker, m_pcb, and BOARD::Test_Drc_Areas_Outlines_To_Areas_Outlines().

Referenced by RunTests().

595 {
596  // Test copper areas for valid netcodes
597  // if a netcode is < 0 the netname was not found when reading a netlist
598  // if a netcode is == 0 the netname is void, and the zone is not connected.
599  // This is allowed, but i am not sure this is a good idea
600  //
601  // In recent Pcbnew versions, the netcode is always >= 0, but an internal net name
602  // is stored, and initalized from the file or the zone properpies editor.
603  // if it differs from the net name from net code, there is a DRC issue
604  for( int ii = 0; ii < m_pcb->GetAreaCount(); ii++ )
605  {
606  ZONE_CONTAINER* test_area = m_pcb->GetArea( ii );
607 
608  if( !test_area->IsOnCopperLayer() )
609  continue;
610 
611  int netcode = test_area->GetNetCode();
612 
613  // a netcode < 0 or > 0 and no pad in net is a error or strange
614  // perhaps a "dead" net, which happens when all pads in this net were removed
615  // Remark: a netcode < 0 should not happen (this is more a bug somewhere)
616  int pads_in_net = (test_area->GetNetCode() > 0) ?
617  test_area->GetNet()->GetNodesCount() : 1;
618 
619  if( ( netcode < 0 ) || pads_in_net == 0 )
620  {
621  addMarkerToPcb( fillMarker( test_area,
623  m_currentMarker = nullptr;
624  }
625  }
626 
627  // Test copper areas outlines, and create markers when needed
629 }
#define DRCE_SUSPICIOUS_NET_FOR_ZONE_OUTLINE
copper area has a net but no pads in nets, which is suspicious
Definition: drc_stuff.h:63
Class ZONE_CONTAINER handles a list of polygons defining a copper zone.
Definition: class_zone.h:78
int GetNodesCount() const
Function GetNodesCount.
MARKER_PCB * fillMarker(const TRACK *aTrack, BOARD_ITEM *aItem, int aErrorCode, MARKER_PCB *fillMe)
Function fillMarker optionally creates a marker and fills it in with information, but does not add it...
BOARD * m_pcb
Definition: drc_stuff.h:205
void addMarkerToPcb(MARKER_PCB *aMarker)
Function addMarkerToPcb Adds a DRC marker to the PCB throught the COMMIT mechanism.
Definition: drc.cpp:90
int GetAreaCount() const
Function GetAreaCount.
Definition: class_board.h:1051
int GetNetCode() const
Function GetNetCode.
MARKER_PCB * m_currentMarker
Definition: drc_stuff.h:176
bool IsOnCopperLayer() const
Function IsOnCopperLayer.
Definition: class_zone.h:179
ZONE_CONTAINER * GetArea(int index) const
Function GetArea returns the Area (Zone Container) at a given index.
Definition: class_board.h:1022
int Test_Drc_Areas_Outlines_To_Areas_Outlines(ZONE_CONTAINER *aArea_To_Examine, bool aCreate_Markers)
Function Test_Drc_Areas_Outlines_To_Areas_Outlines tests area outlines for DRC: Tests areas inside ot...
NETINFO_ITEM * GetNet() const
Function GetNet Returns NET_INFO object for a given item.
void DRC::updatePointers ( )
private

Function updatePointers is a private helper function used to update needed pointers from the one pointer which is known not to change, m_pcbEditorFrame.

Definition at line 335 of file drc.cpp.

References PCB_BASE_FRAME::GetBoard(), DIALOG_DRC_CONTROL_BASE::m_ClearanceListBox, m_drcDialog, m_pcb, m_pcbEditorFrame, m_unconnected, DIALOG_DRC_CONTROL_BASE::m_UnconnectedListBox, DRCLISTBOX::SetList(), and DIALOG_DRC_CONTROL::UpdateDisplayedCounts().

Referenced by Drc(), DrcBlind(), ListUnconnectedPads(), RunTests(), and ShowDRCDialog().

336 {
337  // update my pointers, m_pcbEditorFrame is the only unchangeable one
339 
340  if( m_drcDialog ) // Use diag list boxes only in DRC dialog
341  {
344 
346  }
347 }
DIALOG_DRC_CONTROL * m_drcDialog
Definition: drc_stuff.h:206
void UpdateDisplayedCounts()
Definition: dialog_drc.cpp:690
void SetList(DRC_ITEM_LIST *aList)
Function SetList sets the DRC_ITEM_LIST for this listbox.
BOARD * GetBoard() const
DRCLISTBOX * m_UnconnectedListBox
BOARD * m_pcb
Definition: drc_stuff.h:205
DRCLISTBOX * m_ClearanceListBox
Class DRC_LIST_MARKERS is an implementation of the interface named DRC_ITEM_LIST which uses a BOARD i...
PCB_EDIT_FRAME * m_pcbEditorFrame
The pcb frame editor which owns the board.
Definition: drc_stuff.h:204
Class DRC_LIST_UNCONNECTED is an implementation of the interface named DRC_ITEM_LIST which uses a vec...
DRC_LIST m_unconnected
list of unconnected pads, as DRC_ITEMs
Definition: drc_stuff.h:208

Friends And Related Function Documentation

friend class DIALOG_DRC_CONTROL
friend

Definition at line 160 of file drc_stuff.h.

Referenced by ShowDRCDialog().

Member Data Documentation

bool DRC::m_abortDRC
private

Definition at line 178 of file drc_stuff.h.

Referenced by DRC().

bool DRC::m_doCreateRptFile
private

Definition at line 170 of file drc_stuff.h.

Referenced by DestroyDRCDialog(), DRC(), and ShowDRCDialog().

bool DRC::m_doFootprintOverlapping
private

Definition at line 171 of file drc_stuff.h.

Referenced by doFootprintOverlappingDrc(), DRC(), and RunTests().

bool DRC::m_doKeepoutTest
private

Definition at line 169 of file drc_stuff.h.

Referenced by DRC(), and RunTests().

bool DRC::m_doNoCourtyardDefined
private

Definition at line 172 of file drc_stuff.h.

Referenced by doFootprintOverlappingDrc(), DRC(), and RunTests().

bool DRC::m_doPad2PadTest
private

Definition at line 166 of file drc_stuff.h.

Referenced by DRC(), and RunTests().

bool DRC::m_doUnconnectedTest
private

Definition at line 167 of file drc_stuff.h.

Referenced by DRC(), and RunTests().

bool DRC::m_doZonesTest
private

Definition at line 168 of file drc_stuff.h.

Referenced by DRC().

DIALOG_DRC_CONTROL* DRC::m_drcDialog
private

Definition at line 206 of file drc_stuff.h.

Referenced by DestroyDRCDialog(), DRC(), ShowDRCDialog(), and updatePointers().

bool DRC::m_drcInProgress
private

Definition at line 179 of file drc_stuff.h.

Referenced by DRC().

wxPoint DRC::m_padToTestPos
private
PCB_EDIT_FRAME* DRC::m_pcbEditorFrame
private

The pcb frame editor which owns the board.

Definition at line 204 of file drc_stuff.h.

Referenced by addMarkerToPcb(), DRC(), Drc(), RunTests(), ShowDRCDialog(), testUnconnected(), and updatePointers().

wxString DRC::m_rptFilename
private

Definition at line 174 of file drc_stuff.h.

Referenced by DestroyDRCDialog(), and ShowDRCDialog().

double DRC::m_segmAngle
private
wxPoint DRC::m_segmEnd
private
int DRC::m_segmLength
private
DRC_LIST DRC::m_unconnected
private

list of unconnected pads, as DRC_ITEMs

Definition at line 208 of file drc_stuff.h.

Referenced by testUnconnected(), updatePointers(), and ~DRC().

int DRC::m_xcliphi
private

Definition at line 201 of file drc_stuff.h.

Referenced by checkClearanceSegmToPad(), checkLine(), doTrackDrc(), and DRC().

int DRC::m_xcliplo
private

Definition at line 199 of file drc_stuff.h.

Referenced by checkClearanceSegmToPad(), checkLine(), doTrackDrc(), and DRC().

int DRC::m_ycliphi
private

Definition at line 202 of file drc_stuff.h.

Referenced by checkClearanceSegmToPad(), checkLine(), doTrackDrc(), and DRC().

int DRC::m_ycliplo
private

Definition at line 200 of file drc_stuff.h.

Referenced by checkClearanceSegmToPad(), checkLine(), doTrackDrc(), and DRC().


The documentation for this class was generated from the following files: